topic Re: Tips for text in 3D Part & Assembly Design

Tips for text

KevinBradberry — Fri, 04 May 2018 21:45:37 GMT

Here's an open discussion for text and notes in Creo and Pro-engineer. Add tips and tricks that you know and ask questions that would be a good addition to this topic. If you know of any previous threads that will compliment this topic please provide us the link.

Re: Tips for text

KevinBradberry — Wed, 04 Apr 2012 12:32:47 GMT

GD&T

• Use parametric GD&T when you can, and try this if you want to create a custom note.

Type this as the text:

And get this as the note:

• Notice that you type @[ before the symbol and then type @] after the symbol to create a box around it.

Re: Tips for text

KevinBradberry — Wed, 04 Apr 2012 17:19:29 GMT

Superscript

Type this as the text:

25 ft@+2@#

And get this as the note:

Notice that @+ goes before the text to be superscripted, and @# goes after.

Subscript

Type this as the text:

C@-6@#H@-12@#O@-6@#

And get this as the note:

Notice that @- goes before the text to be subscripted, and @# goes after.

Re: Tips for text

JonathanHodgson — Mon, 16 Apr 2012 14:47:50 GMT

Multiple formats within single note

To edit the style of one section of a note, first click to select the entire note, then click again to select just the section you want to change. You can then RMB -> Text Style... and change size etc as required.

This works directly with separate lines within a note, but to change just one part within a line you must first separate that section by adding {1: and } around the relevant text:

{1:Large Text} Small Text

Separate Line

Then close the note editor and proceed as above.

Re: Tips for text

BrianMartin — Tue, 17 Apr 2012 15:25:02 GMT

Hi Kevin...

The links didn't seem to work. I know what they're supposed to show... but they're not showing!

Re: Tips for text

KevinBradberry — Tue, 17 Apr 2012 15:38:11 GMT

What links?

Re: Tips for text

BrianMartin — Tue, 17 Apr 2012 15:48:05 GMT

Superscript and subscript examples didn't pop up... and they didn't appear as graphics. Although in your previous message the GD&T stuff DID show properly.

Re: Tips for text

KevinBradberry — Tue, 17 Apr 2012 15:58:56 GMT

Now I see what you mean, the images are not linking to larger images. I'm not getting the options for Delte or Edit on that post (but, oddly, those options are available on the GD&T post) so I'll insert them here. Thanks Brian.

Re: Tips for text

BrianMartin — Tue, 17 Apr 2012 17:38:36 GMT

Next you should cover other nifty tricks like overriding dimensions with special text, displaying dimension symbols (instead of values) for tabulated drawings, and methods to import true type fonts for use in drawings.

Oh yeah and also show how to do a superscript over top of a subscript (as if you're showing a limit or plus/minus dimension)!

I'd do it... but I'm lazy. And I'm behind on my presentation!

Re: Tips for text

SylvainA. — Wed, 23 May 2012 11:04:39 GMT

In addition to KevinBradberry tip:

Add superscript first and then subscript.

Re: Tips for text

SylvainA. — Wed, 23 May 2012 11:08:31 GMT

To insert text symbol directly from the keyboard (text symbol as a font): press CTRL+A when in a Note Properties window.

To come back to standard font, press CTRL+B.

In the exemple below I typed "azertyuiop"

Re: Tips for text

SylvainA. — Wed, 23 May 2012 11:29:15 GMT

To round the value of a parameter called in a note, add [.X] after the parameter name, X being the number of decimals.

Re: Tips for text

SylvainA. — Wed, 23 May 2012 11:36:27 GMT

To see the result of a note change without closing the note window, simply click on your drawing's background when the changes are done.

It will act like a "Preview" button.

Re: Tips for text

Dale_Rosema — Mon, 09 Jul 2012 13:24:34 GMT

What was the trick for putting in your own dimension?

It has something to do with @D0 or something and then you type in your own dimension.

Re: Tips for text

DomenicLaritz — Mon, 09 Jul 2012 13:36:39 GMT

@OmyOwnDimension - @O overwrites the default content

Re: Tips for text

Dale_Rosema — Mon, 09 Jul 2012 13:58:14 GMT

Thanks. That is what I was looking for. Just remember it's an "O" (oh) and not a zero.

Re: Tips for text

BrianMartin — Mon, 09 Jul 2012 16:21:00 GMT

Hi Dale...

In Wildfire 5 and beyond there's also a radio button for "Override" on the Dimension Properties window that does the same thing.

Thanks!

-Brian

Re: Tips for text

TomD.inPDX — Mon, 09 Jul 2012 17:54:31 GMT

If you don't want to mess with pen tables and you export PDF drawings, try assigning "thickness" to your text.

I use .012 in in/lb (SAE) drawings providing nice crisp text in the PDF export.

Also, a nice font for distinguishing 1 (one) from I (upper case i) and l (lower case L) is ISO30985FONT. It is the closest thing I found to the Creo Direct Modeling default HP font.

Re: Tips for text

TomD.inPDX — Mon, 09 Jul 2012 19:19:52 GMT

Anyone know how to create the Feature Control Frame B below?

Re: Tips for text

BrianMartin — Mon, 09 Jul 2012 19:32:30 GMT

Hi Antonius...

That's called a Composite Tolerance. from the Datum Refs tab, select the radio button for Composite Tolerance. See below. If you need help with the other stuff (diameter symbols, etc) just let me know.

Thanks!

-Brian