AFX Profiles in WINDCHILL

[avillena]

Hello to all,

I'm trying to configure AFX to use profiles already uploaded to Windchill. I have created custome profiles that I can use if they are in my library folders, but once I upload them to Windchill, and delete the parts from my library folder, AFX can't find them in Windchill.

I have uploaded the profiles to Windchill:

I have "sel_list..txt" pointing at them:

And when I try to assemble a profile instance in the project using these profiles, I get the error message "An error occurred while loading the model":

I have tried with the AFX "options.cfg" properties suggested in this article https://support.ptc.com/appserver/cs/view/solution.jsp?n=CS256023:

"FOR_INTRALINK_33 to YES"

"LOAD_COPY_COMPONENTS_FROM_INTRALINK to YES"

But it still doesn't work.

What am I doing wrong? Is is possible to use profiles from Windchill? Where can I find a guide to configure AFX to be used with profiles from Windchill?

Thank you for your help!

[SamuelBrantner · Accepted solution]

Hi @avillena,

Currently for profiles it is not possible to store the template parts for the different profile types in Windchill.

Regards Sam

[avillena]

Thanks for the info!

Then I will store the complete AFX library in a shared folder for the complete company, and use it from there.

[msteed]

Hello, Sam.

I would like to have the AFX parts to come in with our organization's standard part layers, parameters, and relations. If possible, how would I go about setting this up?

Best regards,

Matt

[SamuelBrantner]

Hi @msteed,

you can find the answer to your question in this Topic.

Greetings Sam

[msteed]

Perfect!

Thank you, Sam.

Matt

[msteed]

Hello, Sam.

Could you provide me with an example of how to apply the AFX Component Naming Scheme so that all my profiles will have PROJECT_SHORT#-#ELEMENT_NUMBER?

I am not certain which directory to save the element_name.txt file to.

http://support.ptc.com/help//archive/creo40/creo_pma/usascii/index.html#page/advanced_framework%2FTo_Define_a_Component_Naming_Scheme.html%23

Thanks,

Matt

[SamuelBrantner]

Hi @msteed,

just place the element_name.txt file in folder <creo>/common files/afx/parts/profiles, equipment, connectors, subassemblies.

Regards 

Sam

[msteed]

Excellent!. Thank you, Sam.

Matt

[msteed]

Hello, Sam.

How would I go about storing and mapping to the AFX template part library on a team accessible common location (share drive)?

I have experimented with the option below, in options.cfg, but have not been able to get it to work.

!Enter AFX library path.
EFX_LIBRARY_PATH

Thanks,

Matt

[SamuelBrantner]

Hi @msteed ,

just copy the complete parts folder in a network location that you have mapped as network drive and also all your colleagues.

So for example put it in p:/afx_custom_libraray/parts. 

Now you set the option to point to p:/afx_custom_libarary/

Note that you custom directory must contain the folder parts.

Hope that helps.

Greetings Sam

[msteed]

Hello, Sam.

Thank you for the instructions.

Nonetheless, I copied the parts folder to:

C:\Users\user\Documents\Creo\Work\AFX_Customizations\parts

and customized (added my layers and parameters) to the angles_eq.prt and am getting a blank library (please see below image). Please let me know if there is anything I may have missed in the above instructions.

Thank you,

Matt

[SamuelBrantner]

Hi @msteed ,

hm I don't understand that. 

What AFX Version are you using?

and

What is the value of the custom folder option?

Greetings Sam

[msteed]

Hello, Sam.

From your previous message, I am using:

Creo Advanced Framework Extension 4.0 M030 - AFX Lite

Also, the value for the custom folder option is:

!Enter AFX library path.
EFX_LIBRARY_PATH C:\Users\user\Documents\Creo\Work\AFX_Customizations\parts

Please let me know if you notice anything that I may have done incorrectly.

Thanks,

Matt

[SamuelBrantner]

Hi @msteed ,

the value of the config option is not correct. Please remove the "parts" Folder from your option value like so:

!Enter AFX library path.
EFX_LIBRARY_PATH C:\Users\user\Documents\Creo\Work\AFX_Customizations\

[msteed]

Excellent!

Also, regarding the param_relations.txt file, would you know of a way to specify certain relations as Initial or Post Regeneration?

I have copied my param_relations.txt contents below. The relation WEIGHT=PRO_MP_MASS should be Post regeneration, but all others should be Initial.

If you have any ideas on this topic, please let me know.

NAMING = BUW_NAME
DESIGNATION = BUW_TYPE + " " + BUW_SIZE + " x " + BUW_LENGTH_STR
LENGTH = BUW_LENGTH
/***** SSC DEFAULT RELATIONS *************
/***** DO NOT DELETE **************************
DESCRIPTION=DESCRIPTION_1+" "+DESCRIPTION_2
STOCKSIZE=STOCKSIZE_1+" "+STOCKSIZE_2
MATERIAL=MATERIAL_PARAM("MTL_D1")+" "+MATERIAL_PARAM("MTL_D2")
MATERIAL_SPEC=MATERIAL_PARAM("MTL_SPEC")
/******************************************************
/***** SSC DEFAULT RELATIONS *************
/***** DO NOT DELETE **************************
WEIGHT=PRO_MP_MASS
/******************************************************
STOCKSIZE_1=BUW_SIZE+" x "+BUW_LENGTH_STR

As usual, your expertise with Creo AFX is highly appreciated. Thank you, Sam.

Matt

[SamuelBrantner]

Hi @msteed ,

the answer to your question is here:

https://support.ptc.com/help/creo/creo_pma/r6.0/usascii/#page/advanced_framework%2FTo_Add_a_Relation_File.html

Just add a param_relations_post_regen.txt.

Also for the future, please make separate topics for your questions so everyone can benefit from it 🙂

Greetings Sam

[msteed]

Thank you, Sam. You guys are awesome!