cancel
Showing results for 
Search instead for 
Did you mean: 
cancel
Showing results for 
Search instead for 
Did you mean: 

Community Tip - You can subscribe to a forum, label or individual post and receive email notifications when someone posts a new topic or reply. Learn more! X

Translate the entire conversation x

Assembly Cut Stopped Working

Dale_Rosema
23-Emerald III

Assembly Cut Stopped Working

I have an assembly cut that has stopped working no matter how much I fidget with it. I've tried redefining the planes in sketch set-up, reference planes, adjusting the dimensions, restarting Creo, ....

 

If I add a new cut, the cut works fine.

 

Dale_Rosema_0-1748529706016.png

 

Dale_Rosema_1-1748529722252.png

 

There are 50 instances in the family table, so if I can help it, I would like to not redo the cut.

 

Using 10.0.7.0 for a long time.

ACCEPTED SOLUTION

Accepted Solutions

Its possible I right clicked on the one in the box and removed it before turning it back on.

View solution in original post

11 REPLIES 11

Reproduced in Creo 11.0.0.0 upon open.

 

I turned off automatic update, turned it back on and it worked. If it continues to be a problem maybe you could turn off automatic update and just manually select the components if that works for your work flow.

 

Screenshot 2025-05-29 113138.png

Dale_Rosema
23-Emerald III
(To:Chris3)

I tried toggling "Automatic Updates" to no avail.

I tried turning off Automatic Updates, exiting the command, opening it back up and turning Automatic updates back on - no success.

I tried opening an instance and repeated the (2) steps above and it still will not cut.

I tried verifying all the instances in the family table ....

Dale_Rosema
23-Emerald III
(To:Chris3)

When I uncheck - Automatic Updates it shows Advanced Intersections checked.

Lower is shows Default Display Level with (3) options:

Dale_Rosema_0-1748537056966.png

 

Should I select part level? What about the Add Instance box. (Not sure why this started happening now...)

 

Its possible I right clicked on the one in the box and removed it before turning it back on.

StephenW
23-Emerald III
(To:Dale_Rosema)

like @Chris3  said, I have the problem semi-regularly/randomly. I have recently turned off the whole automatic intersection by default so I have to choose what gets cut...I don't know if that will help in the long run or if I am just confusing co-workers.

Dale_Rosema
23-Emerald III
(To:StephenW)

How do you "choose" what gets cut...

You click the add intersected models button. See above screenshot.

Chris3
21-Topaz I
(To:StephenW)

We have the config auto_update_intersected_models no turned on so that box is not checked and all of our users have to manually pick by default. Assembly cuts are bad news for large assembly management and we discourage them.

StephenW
23-Emerald III
(To:Dale_Rosema)

@Dale_Rosema .Did you get it fixed?

When I opened the model, I saw exactly what you saw. 

I edited the cut,  unclicked the "automatic updates" and then RMB removed the part selected.

Then I reselected the part manually. Ok Done. Seems to be working fine...I have no idea why it does this. I also avoid assembly cuts where possible. I'll jump thru 100 hoops to skip 1 assy cut. Years ago I did a small test on an assembly (probably Wildfire 2) and the time penalty alone was significant. With large assemblies, it's horrible and then these random odd things make for extra reasons to find a different way.

StephenW_0-1748543359278.png

 

Dale_Rosema
23-Emerald III
(To:StephenW)

Uncheck Automatic Update

Remove Models from Intersected Models

Exit out of operation.

Open up the operation.

Check Automatic Updates

Violà - it worked  (For now at least  🙂 )

 

 

Dale_Rosema
23-Emerald III
(To:Dale_Rosema)

.... for now....

 

I ended up repeating this process with each feature in the tree.....

 

Dale_Rosema_0-1748546033843.png

 

Announcements

NEW Creo+ Topics: Real-time Collaboration

Top Tags