Call custom assembly parameter into BOM

[MS_9892725]

Dear Team,

I have created a custom parameter into the assembly, Now I want to call this parameter into BOM table. I know how to use repeat region, but I am not able to call the assembly custom parameter into drawing BOM table. Please help. 

[MartinHanak]

Hi,

according to https://support.ptc.com/help/creo/creo_pma/r10.0/usascii/index.html#page/detail/System_Parameters_for_Drawings.html

&asm.mbr.MODELPAR displays parameter defined on part/subassembly level

&asm.mbr.cparam.COMPPAR displays parameter defined on assembly component level

[MS_9892725]

Hi Martin,

Thanks for info, I had checked that, but it is not working.

[MartinHanak]

---

@MS_9892725 wrote:

Hi Martin,

Thanks for info, I had checked that, but it is not working.

---

Hi,

such brief communication does not enable me to help you. please provide more information, picture, Creo data

[MartinHanak]

---

@MS_9892725 wrote:

Hi Martin,

Thanks for info, I had checked that, but it is not working.

---

Hi.

open uploaded drawing saved in Creo 7.0.

[MS_9892725]

Hi Martin,

I have tried this, but not solve the purpose. I have provided some snapshot for your reference.

[MS_9892725]

Please check the below snapshots.......

1. I have created Total_Qty parameter in my assembly....

 

  2. Now I want to call this parameter in my BOM Table....... What is the relation I have to use?

 

[MartinHanak]

---

@MS_9892725 wrote:

Please check the below snapshots.......

1. I have created Total_Qty parameter in my assembly....

 

  2. Now I want to call this parameter in my BOM Table....... What is the relation I have to use?

 

---

Hi,

I need to understand what values you want to see in cells in Total Qty column.

I can only try to help you if you give me this information.

[MS_9892725]

It can be any random number, like 2,3,4, or 5

[MartinHanak]

---

@MS_9892725 wrote:

It can be any random number, like 2,3,4, or 5

---

Hi,

I need to understand what is the meaning of Total_Qty parameter. What does this number say?

[MS_9892725]

It indicates no. of qty to be manufactured for this assembly.

[MartinHanak · Accepted solution]

---

@MS_9892725 wrote:

It indicates no. of qty to be manufactured for this assembly.

---

Hi,

if I understand you well then Total_Qty parameter value is related to the component in context of the assembly.

If your Creo version is 7.0 or higher then:

• download my test data set repeat_region.zip (2024-02-19 06:24 PM)
• unzip it
• open t_asm.asm
• open Parameters dialog box ... see following picture

• you can define Total_Qty parameter just as the POS parameter is defined
• close Parameters dialog box
• open t_asm.drw
• edit contents of 3rd cell ... see following picture

• you can enter &asm.mbr.cparam.Total_Qty to display value of Total_Qty parameter

[MS_9892725]

Thank you so much Martin,

It works as expected. 

Can you please tell me how to enter the parameter as a component, because it is not at a part level nor at assembly?

[MartinHanak]

---

@MS_9892725 wrote:

Thank you so much Martin,

It works as expected. 

Can you please tell me how to enter the parameter as a component, because it is not at a part level nor at assembly?

---

Hi,

please see uploaded video.

Note: This is my last reply.

[MS_9892725]

Thanks for the video.

Is it possible to add this component parameter to the assembly start part? so that we don't need to create the parameter every time.

[MartinHanak]

No.

[llie]

MS,

We use &asm.mbr.title in our on drawing BOM.