Creo Parametric 5.0 - Copy of assembly and drawing link

[deleone20]

Is there a way to create a copy of an existing assembly for a new part number, as well as the drawing, while maintaining the link between the new part number and drawing? I tried to make a copy of each, but when I look at the new drawing, it still references the old assembly.

[deleone20]

I resolved the issue. Apparently you can't directly link a new assembly with it's associated drawing through the "Save copy" feature in creo. You have to go through Windchill directly and rename the files there simultaneously. 

[StephenW]

Definitely use windchill to do the save-as, it does a great job of handling the relationships and shows you if you have "unintended" relationships also.

You can also pull in related drawings for sub-components, if desired. It's a great way to take a fully completed design and drawing package and create a copy of the entire package for a new version of the design.

You'll want to learn about the save-as functionality in windchill also. You can use the save as on components in an assembly and during the save as, if you use the "next" button, you can auto-magically replace the old component within your next level assembly with the new component. If your old component has multiple next levels, you can select which ones get replaced with the new component and which ones keep the old component.

[Dale_Rosema]

Sounds like the way to go if..... you have Windchill.

[Dale_Rosema · Accepted solution]

Are you using Windchill or not?

If not:

1. Go into the folder where the drawing and model exist.

2. Copy the drawing and the model into the folder. ( I usually add ZZZZZ in the front of the names.)

3. In Creo, pull up the drawing and model you are going to rename.

4. Rename the drawing and model. Save the drawing and the model.

5. Go into the folder and change copied (not renamed) drawing and model back (scrubbing the ZZZZZ).

6. You should be good to go.

If it is Windchill: 

Someone else will have to chime in.

[LukaszMazur]

There's an easier way: you can add to config.pro option rename_drawings_with_object and set it's value to "part", "assem" or "both". That way you can open a model, save a copy and in the target folder you'll get the model with a new name along with a renamed drawing referencing newly copied model. On the other hand, this will work only, if the model (part or assembly) and the drawing have the same name. If they don't, drawing will not get copied.

[Deepakjohsh]

But sadly, this works only when both the Assembly and the Drawing names are same

Ex:
Assembly = X00001.asm
Drawing = X00001.drw

[Dale_Rosema]

Are you talking about my solution or LukaszMazur's?

My solution can work with mismatched models and drawings because most of mine are.