Hide sketches from drawings

[ELDAFRAWY]

I need to hide sketches shown in drawing views (sketches not quilts).

I do hide it every time I open the drawing file, so I need a permanent solution.

[EdvinTailwind]

You might want to check this setting: autohide_external_sketch

Yes is default - Automatically hides a sketch feature after it is used as the external sketch for a sketch based feature.

In drawings all visible sketches are shown.

[ELDAFRAWY]

The sketches I have are all external ones.

[MartinHanak]

Hi,

please upload your model and explain what is external sketch. If you do this anyone can open the model and give you an advice how to hide  external sketch.

[ELDAFRAWY]

Hello,

EXTERNAL sketches are created before the feature, INTERNAL sketches are created inside the feature.
As the image shows the sketches, I'm talking about are EXTERNAL and the option autohide_external_sketch doesn't work for them, and I can't manage to include them all in one rule.
Unfortunately, I can't upload the file as it has confidential data.

[MartinHanak]

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@ELDAFRAWY wrote:

Hello,

EXTERNAL sketches are created before the feature, INTERNAL sketches are created inside the feature.
As the image shows the sketches, I'm talking about are EXTERNAL and the option autohide_external_sketch doesn't work for them, and I can't manage to include them all in one rule.
Unfortunately, I can't upload the file as it has confidential data.

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Hi,

1.] if you cannot upload real model then (I think) you can create test model and upload it

2.] I tested autohide_external_sketch yes in Creo 7.0.5.0 and it works well ... however, the Sketch feature is hidden only when it is used when creating another feature (eg. Extrude)

3.] as @tbraxton told you, you have to create rule based layer and hide it ... in this case every Sketch feature is automatically included into this layer and hidden

 

[ELDAFRAWY]

Hi,

Done all steps in the last reply, but when I hide the layer including the sketches, they are still visible.

Kindly find the part in the attachments with the pictures.

[MartinHanak · Accepted solution]

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@ELDAFRAWY wrote:

Hi,

Done all steps in the last reply, but when I hide the layer including the sketches, they are still visible.

Kindly find the part in the attachments with the pictures.

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Hi,

I do not have Creo 4.0 M150 installed, therefore I use Creo 7.0.5.0.

There are 2 problems related to your SKETCHES layer.

1.] The layer is empty, because you did not set its properties well. Please select Associative property.

2.] The layer is not hidden.

Select layer, RMB > Hide, RMB > Save Status, save part.

[ELDAFRAWY]

The sketches I have are all external ones. So the autohide_external_sketch option doesn't work with me. 

[StephenW]

Couple of options:

1. In the model, hide the sketches and then switch to the layer tree and use "save status". 

2. In the model, put the sketches on a layer. Then, in the drawing, go to the layer tree and hide that layer, then use "save status". 

"save status" is the function that will keep things you set to hidden.

[tbraxton]

Assuming you are asking about sketched curves. The most robust approach is to put the curves (sketches) on a layer. In drawing mode set this layer display to hidden.

[ELDAFRAWY]

Is there a role to include all EXTERNAL sketches in one layer?

[tbraxton]

You can create rules for layers to include features when they are created. This should work for you r requirements. by adding sketched curves to a layer(s).