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How to make @S DIMENSION AS BASIC DIMENSION?

achopade
4-Participant

How to make @S DIMENSION AS BASIC DIMENSION?

OVERRITED.jpg NEED TO CREATE BASIC @S DIMENSION. HOW TO DO SAME.

ALSO SUGGEST FOR @O BASIC DIMENSION.

Creo

1 ACCEPTED SOLUTION

Accepted Solutions
Chris3
19-Tanzanite
(To:achopade)

For a dimension set to @S, you should be able to just click the basic radio button in the display tab for the dimension properties.

Capture.PNG

For @O you can add @[ and @] before and after your text like this:

@O@[YOUR TEXT GOES HERE@]

View solution in original post

15 REPLIES 15
Chris3
19-Tanzanite
(To:achopade)

For a dimension set to @S, you should be able to just click the basic radio button in the display tab for the dimension properties.

Capture.PNG

For @O you can add @[ and @] before and after your text like this:

@O@[YOUR TEXT GOES HERE@]

achopade
4-Participant
(To:Chris3)

Hello Chris

Thanks for reply;

For @s its only taking whatever mention in name it wont allow spaces.

I need to mention DIM C so I am mention Name as C & in description I am writing DIM @S

It results DIM BASIC C not BASIC DIM C.

Please try with same . I am forcing @S because it will not give any error while running MODELCHECK regenerate.

For @O it is showing : Owerrited dimension as a warning

Chris3
19-Tanzanite
(To:achopade)

I think it is ASME Y14.5 that controls this (although I could be wrong). This behavior is intentional to comply with a standard. Only the dimension gets boxed. If you want something else you need to use the @[ and @]

achopade
4-Participant
(To:Chris3)

Thanks Chris;

It helps me a lot

StephenW
23-Emerald I
(To:achopade)

If you add "dim" to the prefix box, it puts it inside the basic box.

OR

use the coding mentioned by Chris

@[DIM @S@]

to get the desired result without using the basic toggle

achopade
4-Participant
(To:StephenW)

Thanks Stephen;

Helps me a lot

Dale_Rosema
23-Emerald II
(To:achopade)

If either of those we correct. Go ahead and mark it as correct, for those who may search on this topic and find this thread.

tleati
10-Marble
(To:StephenW)

Hi,

 

is it possible to show both the @S and the @D?

That is, let's say I have a dimension named d71 which values 750 mm, could make it displayed like "d71 = 750" ?

 

Thanks

StephenW
23-Emerald I
(To:tleati)

I don't think you can show both, it's always one or the other.

If you was doing it, I might add a drawing dimension to use as the value in shown dimension (using the @s)

@s=&ad### where &ad### is the symbol of the created dimension. I think that might work.

Chris3
19-Tanzanite
(To:tleati)

It is not possible to show both @S and @D you can however add a relation to set the value equal to a parameter or to set another dimension equal to the same and then show the parameter or second dimension.

tleati
10-Marble
(To:Chris3)

Thanks Stephen and Chris.

 

I have put the two parameters in two different dimensions, like this:

 

1.png

 

Is this what you were meaning?

StephenW
23-Emerald I
(To:tleati)

This is what I was refering to with respect to a created dimension.

The @S ("shown " dimension) is d38  and the created dimension is ad64

In the properties of the shown dimension, @s = &ad64

dim and symbol.jpg

 

props.jpg

tleati
10-Marble
(To:StephenW)

Hi Stepehen,

 

ok now I got what you mean, thanks. So I should keep the ad64 dimension in order to display the other d38=225.

I was wondering whether it was possible to have just one dim displaying d38=225.

 

bye

StephenW
23-Emerald I
(To:tleati)

You can't show both the symbol and the dimension without some other trick. Chris' method of createding a parameter that is equal to the dimension and adding that to the text would work well too.

 

You don't have to display the created dimension, just don't delete it. You can erase it.

tleati
10-Marble
(To:StephenW)

Hi Stephen,

 

yes indeed I could erase it, I didn't think about this option.

I was thinking more to the dimension referencing its own value (and not an external one).

 

Thanks

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