Material ID

[ChiselnMallet1]

Hello,

I am having trouble finding the material ID for use in a note.  I have created a new parameter in my material called "SPEC" that I'd like to use in my note.  But I cannot find where to get the MTRL_ID

Thanks for any assistance.

[kdirth]

Is your material ID in the parameter list?  If it is copy the exact name of the parameter.  In your annotation type "&" then the parameter name. (e.g. &MTRL_ID).

[Roy_Crerar · Accepted solution]

Hi, Here is the way I do it.

If your user defined parameter in material is called SPEC then to reuse that as a note the I pull the material parameter into a model parameter. It might work by just doing &material_param("SPEC") but I would create the relation to make SPECIFICATION=material_param("SPEC") then the note is &SPECIFICATION. As it happens I also have IF else statements to show the note as unassigned if the material has not been assigned to the part.

[BenLoosli]

Segment from one of my material files:

{
Name = PDM_NAME
Type = String
Default = 'A36 STEEL'
Access = Full
},
{
Name = DESCRIPTION1_U
Type = String
Default = 'UNS K02599, STEEL'
Access = Full
},
{
Name = DESCRIPTION2_U
Type = String
Default = 'A36 STEEL'
Access = Full
},
{
Name = DESCRIPTION3_U
Type = String
Default = 'A36 ST'
Access = Full
},

Segment from my Relations:

/*** SET MATERIAL PROPERTIES ***
IF PTC_MATERIAL_NAME=="UNASSIGNED"
MATERIAL="UNASSIGNED"
MATERIAL_DESC1="NO MATERIAL ASSIGNED"
MATERIAL_DESC2=""
MATERIAL_DESC3=""
ELSE
MATERIAL=material_param("PDM_NAME")
MATERIAL_DESC1=material_param("DESCRIPTION1_U")
MATERIAL_DESC2=material_param("DESCRIPTION2_U")
MATERIAL_DESC3=material_param("DESCRIPTION3_U")
ENDIF

Once a material is set, the relations pull the parameter information in.

In the model file, we have a saved annotation (material_std_note):

&MATERIAL_DESC1
&MATERIAL_DESC2
&MATERIAL_DESC3

This gets pulled into the drawing.

[ChiselnMallet1]

Why are there 3 different material descriptions?

[BenLoosli]

This is a bad example because A36 is a common material. We use some materials that need the 3 lines for their descriptions to get fully defined. If a description line is blank, it will be blank on the drawing.

[ChiselnMallet1]

Is it possible to put a parameter table in the .mtl?  I notice the syntax the beginning of the file is different from the restricted value parameter files.

ND_RelParSet_K01 = { ***from .mtl first line

ND_ParamDefArr_K01 = { ***from restricted value file first line

and the parameter table line is

ND_ParamTable_K01 = {

Wondering if a table in the .mtl file needs to be something like "ND_RelParTable_K01"?

[ChiselnMallet1]

I was having trouble defining the material's ID in the part file itself.  But eventually found that I didn't need the ID to call it.  That the &material_param("xxxx") method called the active material.

Thanks you for your reply!

[azimmermann-2]

Material ID could be found by adding a material parameter to relationships.

Creo will prompt a list with all available material

select material by name

Creo replaces it with internal ID

[SS4598]

Can you please provide syntax/example to it for understanding it better. 

[BenLoosli]

Log into Creo and go to File-Prepare and then select assign material. You can create a blank material file that will give you the syntax for the material files. In the other thread, I pasted a full file for 7075-T6.

The Creo online help has a section on the Material Library.

[azimmermann-2]

You could start from drawing relationships as well as from model relationships.

Material-ID number could be copy-paste to be used on any note.

[SS4598]

I tried this method

1. Write material= in relations 

2. Go to parameter 

3. Select PTC_MASTER_MATERIAL

 The relation is successfully added but the material ID is not displayed. Can you please let me know where the material ID will be displayed?

[azimmermann-2]

Hi,

For me it shows up on pos 6 (see attached screenshot). E.g. I added the IACS electrical value.

I didn’t try with PTC standard material. Works perfect for materials assigned by me.

Our Standard parts always have materials assigned so I am not able to check out of the box behavior.

Did you follow the steps on drawing?

Go to relationships Add new variable Add parameter > search in “material” > select your material from list > add attribute parameter from available parameter list. After “add selected” and close parameter selection window, MTL ID should show up in relations editor line.