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One-sided diameter dimension

Sergey
13-Aquamarine

One-sided diameter dimension

Hello.

 

How do I show one -sided diametral dimension in Creo drawing application as shown below?

Sergey_0-1638373297327.png

Best regards,

Sergey

 

1 ACCEPTED SOLUTION

Accepted Solutions
StephenWilliams
22-Sapphire III
(To:Sergey)

Select the witness line you want to remove then RMB erase witness line.

Depending on your drawing settings, you will get different results. If you need to, go to file - prepare - drawing properties - detail options change

and set the option clip_dim_arrow_style NONE

then you can "drag" the "none" arrow side to however you want it.

 

StephenWilliams_0-1638374576484.png

 

StephenWilliams_1-1638374599098.png

 

StephenWilliams_2-1638374607781.png

StephenWilliams_3-1638374619627.png

 

 

View solution in original post

8 REPLIES 8

If you use a shown dimension in a drawing view it will appear with arrows across the diameter. After showing the dia dimension use the flip arrows options and it should create what you want.

Sergey
13-Aquamarine
(To:tbraxton)

It is not so simple.

I have made a Detailed view of a cross-section. Center line isn't there to create a diametral dimension. Any thoughts? 

 

Sergey_0-1638374431138.png

 

StephenWilliams
22-Sapphire III
(To:Sergey)

Show your dimension from the model OR create your dimension in the main view and move it to the detail view OR temporarily change your detail view boundary to include the centerline, create the dimension, then re-sketch the boundary as desired.

StephenWilliams
22-Sapphire III
(To:Sergey)

Select the witness line you want to remove then RMB erase witness line.

Depending on your drawing settings, you will get different results. If you need to, go to file - prepare - drawing properties - detail options change

and set the option clip_dim_arrow_style NONE

then you can "drag" the "none" arrow side to however you want it.

 

StephenWilliams_0-1638374576484.png

 

StephenWilliams_1-1638374599098.png

 

StephenWilliams_2-1638374607781.png

StephenWilliams_3-1638374619627.png

 

 

Hello again.

 

Thanks for help. It worked. 
Please, combine both your posts into one so that I will be able to accept it as the complete solution.

 

Sergey

One more question, if I may:

 

How do I convert linear dimension into diametral?

 

Sergey_0-1638375378662.png

 

StephenWilliams
22-Sapphire III
(To:Sergey)

If you've already created it, select the dimension, then in the ribbon, select DISPLAY, then "double value" toggle box

 

If you are creating it, RMB just before placing the dimension and the "double value" option is there.

 

You have to add a diameter symbol

 

StephenWilliams_1-1638376801659.png

StephenWilliams_2-1638376823361.png

 

 

 

 

 

It works. Thanks for the teaching. 

 

(However, there is still some bug in CREO 6, as shown in below snapshot. One dimension is right, the other is wrong)

JS_9824412_0-1638455882107.png

 

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