Pattern of several features

[chshasa1]

Hi All

when i try to pattern some features together, the result is not as expected (see picture).

i do not know where the problem is. "normal" pattern did not work, only geometry pattern.

first grouping the feature did not help as well..

creo file is attached

thanks in advance!

[kdirth]

Geometry patterns are not possible in sheetmetal.  See CS277485 

The external references seem to be preventing a normal pattern.  You will need to remove the external references or pattern each feature separately with a feature pattern.

[chshasa1]

Hi

which external references do you mean exactly?

[kdirth]

The sketches in the cut and flange have external references.

[chshasa1]

Hi 

i removed the external references but still does not work as i wish. 

i also created a new "feature line" for this and it is still not possible to pattern. when i pattern one by one, then the 2. cut out does not work and therefore the following planar feature as well not. 

is it possible to have an example with these 4 steps how it should be done so it works? measures would not be important to have them detailed.

br

[kdirth]

Change the EXTR-CUT feature from "up to next" to "up to selected" and it should pattern correctly.  One of the quirks of Creo.

I have been told once that it is better to use "up to selected" then "up to next" or "through all" for extrudes.  This tells Creo how far to go without it needing to determine what is next or what the extent of the model is.

[kdirth · Accepted solution]

The PLANNER_VERTICAL_STOP feature has the same issue.  Change it to a 0° flat. with end offsets.

[chshasa1]

Hi 

Thanks for the help!
we changed the feature from flat to flange, and now it is working. 

BR