QC Check Points on a Drawing

[Dale_Rosema]

A drawing has a couple of check points: QC_PT1 & QC_PT2.

How can these be shown in one view of a drawing but not in all the other views of the drawing? Is there a way to show points in just one view? Also, you would have to remember to turn these on all the time since typically points on now shown in drawings.

Point turns off

Points turned on, but showing in all views:

This post was similar, but didn't answer what was needed:

https://community.ptc.com/t5/3D-Part-Assembly-Design/Showing-datum-points-on-drawings-when-creating-a-pipe/m-p/428622

[tbraxton]

One option is the following.

Add the QC points to a layer. Hide the layer for the drawing so the points are hidden and do not show up anywhere on the drawing.

Modify the layer display for the view where you want to show the points and unhide the layer for that view only. In drawing mode, you can modify the layer display by view to filter what is shown.

[tbraxton]

This is the UI element where you can select a drawing view to control the display of layers in that view only and not affect the layers set at the top model (drawing) level.

[Dale_Rosema]

Creo 9.0.4.0

In the layer tab, (2) layers were created: Hide_Qc_Pts & Show_Qc_Pts.

If the show layer is activated, they are there. If the hide layer is activated they are hidden. How do I get them to then show up on the one view?

In the layer tree, I have the view that I want them to show up on active but I am not finding how to activate the "Show_Qc_Pts" layer.

[tbraxton]

Only one layer i.e "QC_pts" is needed, not two.

Hide this layer in the top model of the drawing. See the UI snapshot below which is the layer tree in drawing mode. Note that both models and view names (yellow) are available for selection in drop down list. When you hide the layer "QC_pts" in the top model then the points are hidden in all views following the layer assignment.

You would then use the layer tree to modify the layers shown for the view in which you want to show the points. Once you select the view name then you can set show status of all layers for this view without affecting the status created in the previous step. By selecting the view, you can independently control the layer status for the selected view.

[Dale_Rosema]

Given the directions above, does the "show points" have to be on in order to see these?

I have the "hide axis" off yet I can show them by right clicking on a feature. showing annotations, unchecking all the dimensions, switching to the datum tag, clicking on the axis I want to show.

Can you do something similar with the points on the view?

Is this how you turn them on for layer in the one view?

[tbraxton · Accepted solution]

Enclosed is a sample model (Creo 7) and drawing where the points are visible only in one view on the drawing when points are displayed in dwg mode.

Layer tree for the drawing with all layers hidden and the layer tree for the front view (new_view1) with all layers hidden except for layer QC_pts which is shown. See the enclosed video detailing how to implement this.

[Dale_Rosema]

Thanks for the video!!!

So if by default we have the all the displays off (axis, point, csys, plane), the layer setup shown will not work.

[StephenW]

This is a good example of how to do this. 

If you use points, you must have the points display turned on.

You could do the same basic concept with a sketch (a couple more steps) so as not to have the points displayed.

Also, be careful when controlling layers by view. You don't want to go overboard. If you end up with each view having their own layer control and on a large drawing, that's no fun.

[Dale_Rosema]

I marked the solution to my question per the video, but I decided not to go down that road.

The points were used to place dimension on the view.

As @StephenW suggested, sketched points were added where the dimension were.

The points were "related to view" so that if the view was moved, the sketched point will follow the view.

Here is my end result:

[tbraxton]

In the context of showing points in a view associated with your dimensions I would concur with @StephenW approach being preferred. I typically use the layer display method when including much more geometry centric information such as color maps on 3D topology in the model.

I have also used inspection "points" on part designs where discrete locations are specified for a CMM probe to "land" on the part. In that case I have used tabulated dimensional coordinates on the print to facilitate programming of the CMM. On those parts I did display datum points from the model in the view associated with the coordinate table.