weird concurrent engineering snafu

[lylebeidler]

I have a very strange situation that popped up here with Intralink 3.4 and
Wildfire3.



We have a designer/draftsman & an engineer working on the same project. The
designer finished detailing a weld assembly drawing & checked it and the
assembly in. He had the drawing fully detailed, with a large number of
dimensions. Then, the engineer checked out the assembly & drawing, and
added parts to the assembly. When he pulled up the drawing, the only
dimensions on it were shown dimensions for the parts he had just assembled.
All of the designer's work was gone. Any idea why this may have happened?

--



Lyle Beidler
MGS Inc
178 Muddy Creek Church Rd
Denver PA 17517
717-336-7528
Fax 717-336-0514
<">mailto:-> -
<">http://www.mgsincorporated.com>
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[mjenkins]

Anytime you use a large amount of created dimensions they are at risk of going away by some little change.

If you are really pressed for time, you can open a previous version from intralink and save a dxf.

Open the dxf and cut and paste all the dimensions back onto the drawing by using copy 0,0 to 0,0.

You can then at least reattach them instead of creating them all again.

What really sucks is if they are ordinate.

In Reply to Lyle Beidler:

I have a very strange situation that popped up here with Intralink 3.4 and
Wildfire3.



We have a designer/draftsman & an engineer working on the same project. The
designer finished detailing a weld assembly drawing & checked it and the
assembly in. He had the drawing fully detailed, with a large number of
dimensions. Then, the engineer checked out the assembly & drawing, and
added parts to the assembly. When he pulled up the drawing, the only
dimensions on it were shown dimensions for the parts he had just assembled.
All of the designer's work was gone. Any idea why this may have happened?

--



Lyle Beidler
MGS Inc
178 Muddy Creek Church Rd
Denver PA 17517
717-336-7528
Fax 717-336-0514
< -
< http://www.mgsincorporated.com

[MIchael_Ohlrich]

I don't work in Intralink anymore (Windchill now)... Everyone can correct me if I am wrong but, I remember this happening when you don't update your workspace before checking out the parts/assy. It sounds like to me that the engineer in this situation probably had the components/assy in his personal workspace and when the designer checked in his work the engineer started and worked on the older version in his workspace.

Michael Ohlrich, Design Engineer
Benchmade Knife Company
mohlrich@benchmade.com<">mailto:mohlrich@benchmade.com>
(503) 655-6004 x122

[cid:image001.jpg@01CC0A2C.A66B9950]
www.benchmade.com<">http://www.benchmade.com>

[dgschaefer]

Sounds like something that would happen outside a data management tool



By default, any dimensions created in the drawing are not stored in the
drawing file; they are stored in the model file, in this case the weld
assy. So, if the engineer used an older version of the weld assy, he
wouldn't have the dimensions made by the designer.



I would think that Intralink would have taken care of this.



Doug Schaefer

[TrainStopper]

This config.pro setting create_drawing_dims_only NO has given us fits
like this, especially on family tabled parts.

The created dims are embedded in the part so they sort of act like shown
dimensions in that if somebody Deletes them in one drawing they are
deleted in all drawings of that part or family member.

And it may be that if only the drawing was saved with created dimensions
that were actually stored in the model, not storing this model resulted
in losing those dims.

See if you can track down the model from the designer & maybe everything
will be able to be restored.



Try create_drawing_dims_only YES in the future



Regards,

Walt Weiss

[BobSchwerdlin]

I think you are on the right track. Sounds to me like the engineer didn't do an update to the workspace before working on the file.

Bob