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Sketcher - tips, tricks and hotkeys

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Moonstone

Sketcher - tips, tricks and hotkeys

Hello,

l´m using sketcher every day as many of us. Don´t think my work is top productive.

So my question is simply: What tips, tricks or hotkeay are you using in SKETCHER MODE?

Example:

- press SHIFT button and drag the line to make it concident with reference

Every ideas or links are welcome

Thanks in advice

Milan Bonka

15 REPLIES 15

Re: Sketcher - tips, tricks and hotkeys

  • You need to hold CTRL to snap to corners or other sketch entities
  • select dimension(s) and Control+T will make the dimension strong.
  • Select the sketch lines and press Control+G to make them Construction.

Re: Sketcher - tips, tricks and hotkeys

While in the sketch command hitting the RMB has many functions that is not available directly like locking the constraints, lengths, and many more.

Re: Sketcher - tips, tricks and hotkeys

Parametric sketches in models or the sketch tool in drawings, symbols, and formats?

Re: Sketcher - tips, tricks and hotkeys

Parametric sketches in models...

Re: Sketcher - tips, tricks and hotkeys

If you need to add a reference while sketching, you can press Alt + select the needed reference then continue sketching

I also noticed yesterday something. If you select multiple arcs or circles, you can right click and select equal and all the selection will have the same dimension.

Re: Sketcher - tips, tricks and hotkeys

You can build relations in the sketch on the fly by typing the equation in the dimension.  I use "sd1/2" often to create symmetry while being able to display both dimensions on the print.


Creo is an endless adventure: Always more to learn.

Re: Sketcher - tips, tricks and hotkeys

Actually, you don't even need to add references.  Sketch the line, then when adding dims or constraints you can pick the new reference directly.

--
Doug Schaefer | Experienced Mechanical Design Engineer
LinkedIn

Re: Sketcher - tips, tricks and hotkeys

  • Be mindful of your sketcher reference plane.  Not only does it allow you to control what H & V is, Creo will frequently pick a model surface rather than one of the default datums, creating another unnecessary parent child relationship.
  • Always use surfaces for references rather than edges where possible.  They are much more robust.
  • Get the right number and type of entities in when sketching, don't worry about placing them where they need to go.  In fact, I deliberately put them in the wrong place to avoid Creo assuming they should be aligned with something.
  • Add "sketcher_starts_in_3D no" to your config to keep the model in 3D while sketching. Makes selecting references easier, especially when trying to pick surfaces vs. edges (see previous bullet)
  • Don't worry about picking sketcher references ahead of time. Sketch first, then tie things to model geometry after.  It gives you more control over the constraints and references.
  • Be very deliberate about your constraints and references.  I make sure every constraint, dim and reference is exactly the one I want.  These are what determine how your sketch will react to model changes, a little diligence here will pay big dividends later when things change.
  • Watch for Creo over constraining with the H & V constraints.  It often will allow a line to be coincident with a planar surface and H or V.  If that surface changes angle, the sketch fails because it can no longer be H or V.
--
Doug Schaefer | Experienced Mechanical Design Engineer
LinkedIn

Re: Sketcher - tips, tricks and hotkeys

Same for lines...

For example:

Sketch 5 lines - press RMB - select equal ---> all lines have the same lenght