"Additional view" in own different scale

[kfilurin]

In Creo Parametric 2 or 3 in drawing module user can't change a scale of an "additional view" - it have the same scale that general scale of the sheet. Why it's not possible to change? Every time all of users need it, but only one way it's trick to make general view and make a fake arrow Please fix it.

[kfilurin]

Ron, if you voted negative please give me your feedback why)

[RonSt.Pierre]

The request I believe violates fundamental standards: ASME Y14.3 and ISO 128.

[kfilurin]

Creo is an international product and in other standarts, for example russian standart GOST don't exist this requirement. And in the most cad systems it possible to do..

[dmcclinton]

Creo has the ability to make additional views at different scales. see image, view properties dialog window

[RonSt.Pierre]

The last time I looked, GOSTR - Russian Federation State Committee of the Russian Federation for Standardization and Metrology is a representative member body of ISO

Can you show an example of what you do?

[kfilurin]

When i try to change scale of additional view it's blocked. Of course i can change type of view to general and change scale, but i will lost of view arrow..

Ron, yes Russia is a member of ISO. For information - USSR was a one of founders of ISO:)

In GOST even surface finish symbols are different and a lot of different moments)

[RonSt.Pierre]

The views are associated to each other as they should be and follow the "drafting" rules for orthogonal projection as I understand them per ISO and ASME.

In keeping with the rules, the associated view you are attempting to modify has to be dis-associated from the "driving" view as it becomes no longer part of the projected orthogonal views (which means you can no longer do descriptive geometry)

This should be treated differently and is why you are forced to do something different like create another "main view" with it's own characteristics, like scale.

If you did this on the board, (showing my age) you would still have to mark the view with the changed scale (if different from the sheet), mark the view name and designate where the view was derived from since it would no longer be considered part of the main orthogonal projection views.  In doing so, you are able to place this view anywhere on the drawing format.

Just my opinion.... for what its worth......

[dgschaefer]

Perhaps the issue here is not re-scaling projected views, but adding associative arrows to auxiliary views that are not projected and not the same scale.  As stated, and in Konstantin's example, it's about scaling projected views which I'd agree, should not be allowed. 

However, scaling an auxiliary view and maintaining an associative arrow to another view would be nice.

[StephenW]

I simply create a cross section outside of the part so my arrows can be shown using the view properties - section. The view is an authentic view, to the scale I want it to be and it has the arrows I require. The only "added" work I do is adding a cross-section to the model and changing the view name from "section a-a" to "view a-a"

[kfilurin]

Yes, we every time can trick. But i dream that in future Creo will convinient and easy to use software. Let's make it together by our votes and ideas)

Just tried it in SW..

[dgschaefer]

Is that an actual projected view, tied to the parent? Regardless of if it violates drawing standards (which I'd assume it does), it's certainly bad practice and creates an unclear drawing.  Sorry, I'm voting no here.

[kfilurin]

I don't speak about projection connection. I think it's not right, yes. But without this connection, it must to exist. Just additional view (no axial view) with arrov with different scale.

[RonSt.Pierre]

In all fairness, I revisited my founding documents...

It seems that Konstantin does have a valid request, but I think he can not articulate it quite correctly, so hopefully I do it some justice here.

ISO 128 has allowed for some time a third method of view presentation: Layout of views using reference arrows.

This ISO Arrow Method is new to the ASME Y14.3 standard.  It provides a system that does not require the First or Third Angle Projection interpretation and does not require the use of the Projection Symbol near or in the title block. The requirements are:

a. Must be in compliance with ISO 128-30 practices.

b. Arrow Method symbol shown in Figure 7 may be used for all views.

c. To rotate a view, use the Arrow Method symbol

d. The word "VIEW" is not used.

e. The identification letter is placed above the view.

f. The standard view arrangement is not required as in First and Third Angle Projection systems.

                                 Figure 7.  Reference Arrow Method for the Six Principal Views

I have seen this method used by General Motors in the US briefly before heading off to an aerospace company.

So with that said, I believe the request is to have this capability, based on present day standards, to be an additional option for drawing preparation.

Currently we have ISO and ASME, with definition for first or third angle designation, the request is to have the third definition of Arrow Method designation.

While perhaps I may not like it, I can find myself trying to change with the times...

Changing my vote, if I can

EDIT:

This is not too far removed from this request:

Allow Rotated View

[kfilurin]

The likelihood that this will add in Creo almost zero) if even sketch in drawing module still from ancient era)

[Dale_Rosema]

I understand what you are saying with the arrow method, but does it allow different view to be of different scales as per the request above?

[RonSt.Pierre]

I do not have the latest copy but with some searching around on the internet, I found this:

so I can say with a high degree of certainty: yes it does allow for view to be of different scales, so long as it is marked accordingly

ron

[olivierlp]

Hello,

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