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Layer state for part & drawing

SOLVED
RaphMORIN
Aquamarine

Layer state for part & drawing

Hello Community,

 

Is it possible to have different layer state for a part/assembly and its associated drawing.

 

For instance, I have a manufacturing file with many milling windows. I have created a layer driven by a rule to isolate these. I would like to hide milling windows in my manufacturing document for the workshop, and keep these milling windows displayed in the manufacturing assembly.


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1 ACCEPTED SOLUTION

Accepted Solutions

Re: Layer state for part & drawing

Yes, in the drawing, there are 2 options under the drawing layer status:


Steve Williams
Pro/E Version 15/16 (Circa 1995/1996)

View solution in original post

16 REPLIES 16

Re: Layer state for part & drawing

Yes, in the drawing, there are 2 options under the drawing layer status:


Steve Williams
Pro/E Version 15/16 (Circa 1995/1996)

View solution in original post

Re: Layer state for part & drawing

In fact, I'm still having a problem.

In my model I made a layer with a rule to select all milling windows

In the drawing I configured as Stephen shown. In the drawing I hide the layer then save the layer status. I go back to the manufacturing file, the windows are still shown, that's cool. But if I go back to the drawing the milling windows are shown again even if the icon in the layer status shows it's hidden !! (Milling windows are shown in purple on the drawing). What am I doing wrong ?

Re: Layer state for part & drawing

I can only think of one reason, you have that view controlled independently from the drawing layers.

You can see this if you select the arrow icon in the layer tree. Notice on the image below, all the view boundaries are shown in blue (this may be a different color on your setup, I have custom colors assigned). If any of your view are green (or different colors) you have independently controlled the layers for this view.

If you don't want the view to be controlled by the overall drawing layers (recommended), select that view boundary. Then in the layer menu, select DRAWING DEPENDENT.


Steve Williams
Pro/E Version 15/16 (Circa 1995/1996)

Re: Layer state for part & drawing

Thanks Stephen for this answer.

I did what you explain. It's ok until I switch to the manufacturing file, back to the drawing the milling windows are shown again !!

I have to find what I am doing wrong. I f I can't find it by myself I'll open a support case.

Re: Layer state for part & drawing

In my reply above, I mis-typed. The last sentence should have read:

If you want the view to be controlled by the overall drawing layers (recommended), select that view boundary. Then in the layer menu, select DRAWING DEPENDENT.

Instead of "If you don't want"


Steve Williams
Pro/E Version 15/16 (Circa 1995/1996)

Re: Layer state for part & drawing

Hi Stephen,

Thanks for you detailed answer. In fact it works fine with standard parts and drawings, but with manufacturing files it sometimes works sometimes not !! I'm currently working on an old manufacturing file. I'll have a look on a new one.

Re: Layer state for part & drawing

Unfortunately, I don't know anything about the manufacturing side of Creo. I assumed it follows the same rules but possibly not.


Steve Williams
Pro/E Version 15/16 (Circa 1995/1996)

Re: Layer state for part & drawing

There might be a bug or something. I tried on an all new manufacturing file and unfortunately I notice the same behavior. I open a support case.

Re: Layer state for part & drawing

Hello,

Just giving some fresh news about this. I opened a case and the conclusion is that when you use a shaded view in a drawing, it always follows the layer state of the model. To use a different layer state, the view must be defined to something different than shaded view ! So it works to product specification, and I now have to create an idea.

https://support.ptc.com/appserver/cs/view/case_solution.jsp?n=CS43026

Re: Layer state for part & drawing

The link to the idea if you feel concerned : Shaded view layer state different from model

Re: Layer state for part & drawing

This is really interesting. It starts doing some odd things when I play with the layers in the model and drawing once I add the shaded view to the drawing. They are definitely not independently control (drawing/model) once a shaded view is added.


Steve Williams
Pro/E Version 15/16 (Circa 1995/1996)

Re: Layer state for part & drawing

Yep, from my point of view this looks like an unexpected behaviour, but PTC pretends this works to product specification. I really would like to talk to the person who specified that.

Imagine the thing : "Just for the shaded views I decide the layer state will always follows the model layer state" !!

What a strange idea !

Re: Layer state for part & drawing

It's the standard explanation when they don't have an explanation. If you really wanted to pursue it, you can demand to see the specification where that is stated. It is likely not worth the effort on your part to take the time and likely the *best* result you could probably expect is either an admission that they didn't have a specification or that they solved some sort issue by making it behave this way.


Steve Williams
Pro/E Version 15/16 (Circa 1995/1996)

Re: Layer state for part & drawing

Hi Raphael,

Did Stephen's response help answer your question.  If so, please mark it as the Correct Answer, so other users with the same question can find the solution quickly.

Thanks,

Amit

Re: Layer state for part & drawing

Thanks Stephen, this is what I was looking for.

Re: Layer state for part & drawing

Thanks Raphael.

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