is it possible to reroute the original sketching plane?

[al204]

Hello....I have just finished a model in which I have invested 2 weeks of my time...

Now my boss wants me to reorient everything.....the model is finished....but now he wants me to change the sketching plane of the extrusion on which I later built everything else. I created the first extrusion on the TOP plane, now he needs it on the FRONT plane.

How can I do this without messing up all my work? have tried rerouting simple models, but it just doesnt seem to work.

If anybody has a tutorial on this topic, and can share it, it is greatly appreciated.

regards



Alvaro

[gkbeer]

The relevant help page is... file:///C:/*yourproehelploadpoint**
/html/usascii/proe/feature/part_five_sub/to_reroute_features.htm*

[dgschaefer]

Glenn,

That's a good trick, one that I hadn't know of. Thanks for sharing it.

However, the problem will be that many of the later features may
reference the default datum planes. Once turned 90 degrees, those will
fail or regenerate improperly.

I'm thinking it might be easier to copy all the features from the
original to a new empty part like this:

* Create a new part from your start part.
* I like to assembly your original part and the new empty side by
side in a dummy assembly. In a case like this, it will be especially
helpful as you can orient them so that the TOP plane in the original is
aligned with the FRONT in the new.
* Activate the new part in the dummy assembly
* Select Edit -> Feature Operations -> Copy -> FromDifModel -Done
* Pick the original part.
* Holding the shift key, pick your first protrusion in the model
tree then pick your last.
* Click OK.
* Select done and then you'll be walked through the feature
references one by one to pick new ones, much like in Glenn's tip. I
this case, since you've picked all the features, you should only be
prompted for the 3 default planes.
* Pick front for top, top for front and right for right.
* Make sure the direction arrows point in the right direction and
you should be good.

Now, sometimes when doing a big block of features like this, Pro|E get's
confused and fails to recognize that some of the references will be
created by the copied features. If it asks for anything but the 3
planes, this is the case. Things get more complicated then. If that
happens, I can give you some tips on getting around that if you need
them.

Doug Schaefer

[TimMcLellan]

The same thing can be accomplished using a UDF (in this case using all of
the features after the datum planes).



The key thing in either case, as Doug mentioned, is to make sure your arrows
are pointing in the right direction. WF3's UDF's interface has been
improved so you can work through specific issues as you place the data.



Good luck,



Tim McLellan
Mobius Innovation and Development, Inc.

[MarkRafn]

I'd just rename the TOP plane to FRONT 😉
(it's Friday 🙂

-mark

[roger.willson]

That's old school right there!!



Love it.



Cheers,





Roger Willson

-

[dd-brian]

That's the ticket.

Rename the datum planes, re-orient the named views, and modify the
coordinate system. Keep things simple. 😉



_____

[gkbeer]

I thought of that, but all the new features will have different id's. So any
thing that references this from outside the part will fail.

[ptc-46674]

Why would your boss care about the orientation of your model ?????


--- Alvaro Barboza <-> wrote:

> Hello....I have just finished a model in which I have invested 2 weeks of my time...
> Now my boss wants me to reorient everything.....the model is finished....but now he
> wants me to change the sketching plane of the extrusion on which I later built
> everything else. I created the first extrusion on the TOP plane, now he needs it on
> the FRONT plane.
> How can I do this without messing up all my work? have tried rerouting simple
> models, but it just doesnt seem to work.
> If anybody has a tutorial on this topic, and can share it, it is greatly appreciated.
>
> regards
>
> Alvaro
>
>

[Jim.Tierney]

Some companies have a standard that the part needs to be modeled in the
orientation it is assembled. Other places have a standard that it is
modeled so the front view is facing the front of the part.

Not sure on a easy way to do after everything is done.

Jim

[kdemont]

Sounds like micromanagement to me.