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Acess al feature parameters

Regular Member

Acess al feature parameters

I've noticed, that we can acess more feature parameters, than the relations window can show us.

Ex: In a pattern feature I've write the following relation:

 

IF A==1

pattern_tablefid1668="Table1"
ENDIF

IF A==2

pattern_tablefid1668="Table2"
ENDIF

 

 

And it works! My question is, in feature parameters, I'm unable to find the Expression "pattern_tablefid1668", were I can find this expressions, and other ones?

 

6 REPLIES 6

Re: Acess al feature parameters

Hi,

try contacting PTC Support.


Martin Hanák

Re: Acess al feature parameters

Thanks,

 

Anyone can from PTC that assists this forum can help?

Re: Acess al feature parameters

Hi,

you have to go to https://support.ptc.com/apps/case_logger_viewer/cs/auth/ssl/log page and ask PTC Support directly.

Note: I am not sure if you have the right to open Case at PTC Support.


Martin Hanák

Re: Acess al feature parameters

I don't have acess...

Re: Acess al feature parameters

Oh, the hidden gems of Creo :-)

 

In the dark corners of the internet, you can find references of how you can switch pattern tables with relations.

 

Eng-tips (februari 2004)

https://www.eng-tips.com/viewthread.cfm?qid=86497

 

PTC Article CS25675 (juli 2011)

https://www.ptc.com/en/support/article?n=CS25675

 

---

Description
-----------
Using part relations to specify the use of a specific pattern table within a part.


Alternate Technique
-------------------
After creating more than one pattern table, select #Add from the Relations menu 
and enter in the following syntax: 
        pattern_table:fid_(pattern_table_id_number) = "pattern_table_name"

Where pattern_table_id_number is the Feature ID of the first feature in
the pattern and pattern_table_name is the name given to the pattern table.

For example, with two pattern tables, FOUR_HOLES and EIGHT_HOLES, the design
requires that pattern table FOUR_HOLES be used when the LENGTH of a part is 
less than 10 and greater than zero. Pattern table EIGHT_HOLES is to be 
used when the LENGTH of the part is greater than or equal to 10. In this
example ADD the following relation to the part by selecting #RELATION #ADD: 

  IF LENGTH > 0 & LENGTH < 10
        PATTERN_TABLE:FID_21 = "FOUR_HOLES"
  ELSE 
        IF LENGTH > 10 | LENGTH == 10
                PATTERN_TABLE:FID_21 = "EIGHT_HOLES"
        ENDIF
  ENDIF

NOTE: The text for the name of the pattern table *must* be in uppercase letters.
Pro/ENGINEER is case sensitive to this variable, and will issue an error message
if the value contains lowercase letters. 

Re: Acess al feature parameters

One more tip: you can also use the NAME of the pattern (instead of the feature id)

 

Pattern Table FID_Name.PNG