cancel
Showing results for 
Search instead for 
Did you mean: 
cancel
Showing results for 
Search instead for 
Did you mean: 

Editiable annotations/dimensions

SOLVED
Newbie

Editiable annotations/dimensions

Hello all,

 

I have setup a gear within creo and displayed the editable parameters as annotation. The attached picture explains this a little better. My problem is, I can't seem to figure out how to make the annotations clickable so that the values of the parameters can be changed. I want to be able to change the values of the annotated parmeters under the model tab. I have seen this done before, so I know it should be possible. I just cant seem to figure out how. Any help is much appreciated.

Tags (2)
1 ACCEPTED SOLUTION

Accepted Solutions
Highlighted

Re: Editiable annotations/dimensions

To do it in the part model, create an annotation note and reference your parameters with a &. See image below. When you double-click the annotation in the model, it will prompt you for the value of the parameter you double-clicked.

annotate.JPG

Edit: I should clarify that the parameters in the image above are named z_height, etc. Doing this in a drawing would be very similar.

View solution in original post

14 REPLIES 14
Highlighted

Re: Editiable annotations/dimensions

To do it in the part model, create an annotation note and reference your parameters with a &. See image below. When you double-click the annotation in the model, it will prompt you for the value of the parameter you double-clicked.

annotate.JPG

Edit: I should clarify that the parameters in the image above are named z_height, etc. Doing this in a drawing would be very similar.

View solution in original post

Highlighted

Re: Editiable annotations/dimensions

This puts the annotation within the model, however I still can not click it to edit the parameters.

Highlighted

Re: Editiable annotations/dimensions

It works on my end. A few things to check:

  • Do you have a filter applied in the bottom right corner of your screen? It should be set to smart.
  • What version of Creo are you running?
  • Are the parameters in your model or a subassembly or another model?
  • Does the & show up in the annotation when viewing it from the model?
  • Do you have a relation that drives and defines these parameters?
  • Are you double-clicking the value of the parameter you want to change? A small window at the top of the screen should open up, asking you to enter a new value. If you click on another word in the annotation, it won't work.
Highlighted

Re: Editiable annotations/dimensions

1.) No filter, it is set to smart.

2.) I am running Creo 2.0, the latest version.

3.) The parameters are all in the model.

4.) I tried doing this in a model withiout any relations and with reltations, doesn't change anything.

5.) I cannot double click the annotation note. It acts like static text, at this point I am almost thinking it may be something with the config file disabling editable annotation within the modeling enviroment.

Thanks for the replies.

Highlighted

Re: Editiable annotations/dimensions

Do you have a relation that explicitly defines the parameters? If the value is called out in the relation, it will be locked.

Highlighted

Re: Editiable annotations/dimensions

I am having the same problem as Chris. Double clicking always opens the annotation dialog instead of the value dialog.

Eric, can you share the file you have working?

Highlighted

Re: Editiable annotations/dimensions

Here you go. I had to create it from scratch since I deleted the orginal. One more thing, I was wrong about the selection filter. I have to be on the annotations tab or else hold down ALT. I'm going to look through my config to see if I have anything in there that might help.

annotate2.JPG

Highlighted

Re: Editiable annotations/dimensions

I figured it out, I wasn't adding it as an annotation feature. I had been just leaving it as a note, therefore it would only bring up the properties box. Adding it as an annotation feature and then holding alt I can change the individual parameters. Thanks alot Eric and Antonius!

Highlighted

Re: Editiable annotations/dimensions

Oh good. I was wondering if I was beginning to loose the rest of my mind for a minute there. Glad it's working!

Announcements
Message from Brian Thompson (PTC General Manager and DVP) regarding Creo Business Continuity plans.