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"Name Already Exists" (Can you find it????)

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"Name Already Exists" (Can you find it????)

In the attached part, I'm converting the center axis (A_34)to a set datum, and trying to change the name to "B". I get the error: "Name Already Exists". Only problem is... it doesn't exist! At least not that I can find. I'm running Wildfire 4.0 - M180. I've attached the part if anyone would like to take a stab at it. Appreciate any input.

10 REPLIES 10

RE: "Name Already Exists" (Can you find it????)

Open a new part file and copy the features over "from different model" and "independent" using new refs. This

RE: "Name Already Exists" (Can you find it????)

Oh and I just realized you have features copied froman external model that is missing. There could be afeaturenamed "B"in there somewhere preventing you from using it.

RE: "Name Already Exists" (Can you find it????)

Yep...it's in your copied features somewhere. I deleted the features with the external refs, copied the remaining features to a new part and named an axis to "B"

RE: "Name Already Exists" (Can you find it????)

Thanx Dean... great insights into this issue. I've always known Pro/E is real "grabby" and doesn't seem to "forget" anything! Unfortunately, this part is one of a large assembly and needs the references shown here as missing. (When in assembly, they're fine.) I think I'll go ahead and just use another name for the datum axis, and press on. Thanks for digging into this though... I learned something!


Steve

"Name Already Exists" (Can you find it????)

If the existing name comes through in a top down design Publish/Copy
Geometry fashion I use this workaround to free the name.
Rename the feature on the publish side. (B -> Brenamed)
Regenerate the Copy Geometry so the new name comes in.
The B name is now free un the Copy Geometry side and can be used.
Rename the feature on the publish side back (Brenamed -> B)
Regenerate the Copy Geometry. As B is now in use in this model, ProE will
assign default name to the incoming feature name.

The original model will be unchanged after this, so no problems against
any data management systems either.

The same method can be used for an Inheritance model if needed.

Regards,
Bjarne



Steve Prout <->
14-07-2011 16:20
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[proecad] - RE: "Name Already Exists" (Can you find it????)






Thanx Dean... great insights into this issue. I've always known Pro/E is
real "grabby" and doesn't seem to "forget" anything! Unfortunately, this
part is one of a large assembly and needs the references shown here as
missing. (When in assembly, they're fine.) I think I'll go ahead and
just use another name for the datum axis, and press on. Thanks for
digging into this though... I learned something!
Steve

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"Name Already Exists" (Can you find it????)

Hi Bjarn,

For existing Publish/Copy features coming in, there is even a shorter way. In the target model, do Edit > Setup > Name > Other and select the item you want to rename (not the feature itself). You should get an input field in the message area. At least, this is working in WF3.

Met vriendelijke groeten, Hugo.

NV Michel Van de Wiele
Carpet and Velvet weaving machines
M. Vandewielestraat 7
8510 Marke, Belgium

Creo Color Scheme

I am finding Creo 1.0 Interface color scheme a bit harsh/hot.



In particular, I would like to know if there is a way to change the color
around the menus, icons, to be something other than white?



Tim McLellan
Mobius Innovation and Development, Inc.

Creo Color Scheme

Second that here. I have to model with a welders mask.



Steve





Stephen Seymour, MSME, P.E.

Principal Engineer

Seymour Engineering & Consulting Group, LLC

3600 NW 138th Street

Suite #102

Oklahoma City, OK 73134

"Name Already Exists" (Can you find it????)

Sorry for the delay in responding, vacation and all... Found this solution to this issue a while back; when you name a datum feature and then delete the feature and the name is "locked off". AND you need to USE the name for something else... typically it's something like a -A-, -B- or -C- datum... You can run a simple example by creating an extrusion with a hole in it, setting the hole axis to datum -A- then redefine the sketch, deleting the hole (and thus the axis) which will "lock off" the name -A-. If you follow the steps below, you can "free up" the name...
[cid:184292009@18072011-29ED]

The tricky part is that you HAVE to use the edit definition box to do the renaming... IF you simply select the item, RMB and hit Properties, you'll get the "name already exists" when you try to rename to the "locked off" name.
[cid:184292009@18072011-29F4]

And then select the properties tab:
[cid:184292009@18072011-29FB]

I got this to work just as described. It seems to "flush" the name that's locked up out of the system so you can use it where you NEED to.
Pass this along to whomever you think might need it...


Thanks...

Paul Korenkiewicz
FEV, Inc.
4554 Glenmeade
Auburn Hills, MI., 48326

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