cancel
Showing results for 
Search instead for 
Did you mean: 
cancel
Showing results for 
Search instead for 
Did you mean: 

Shaft FEA simulation torque and constraints

SOLVED
Highlighted
Participant

Shaft FEA simulation torque and constraints

Hello everyone,

I am trying to perform a fea on a shaft with 2 inputs (10000 lb*ft), supported by 2 bearings.

Instead of putting a constraint at the output gear I thought it would be better to apply a torque

opposite to the input torque, in this case -20000 lb*ft.

The stress and deflection I obtain don't seem correct. The shaft rotates in the direction of

the input torque (more than one full rotation, the output torque doesn't seem to have any effect), it shrinks and on the output gear it

is showed a high localized stressed area, which I cannot justify.

If I substitute the output torque with a constraint that fix rotations the result seems to be correct, but

I would like to investigate the reason why applying opposite torques doesn't work.

I add that if I run the model with only input torques the fea still runs, even if I should get an error because the system is not isostatic and the shaft can rotate on its axis.

I hope someone can help me on this.

 

Thank you

Daniele

1 ACCEPTED SOLUTION

Accepted Solutions

Re: Shaft FEA simulation torque and constraints

11 REPLIES 11

Re: Shaft FEA simulation torque and constraints

Re: Shaft FEA simulation torque and constraints

I checked your model. The torques you applied are not balanced, if I balance them I get a result

really similar to mine, with a concentrated spot on the central gear and extremely high stresses. From the deflections I see that the shaft is spinning even if torques are balanced.

Re: Shaft FEA simulation torque and constraints

Your problem is that Input_left and Input_right are not applied to the model.  They are applied to surfaces that are not part of the model from Extrude1 and Extrude2.  You need to instead create surface or volume regions on the simulate side to split the regions on the ends of the part.  In effect the full 20000 ft-lbf was applied to skunks spring instead of the small residual.

 

Finally, two choices to remove the small residual. (EDIT -choice A requires no constraints, only loads like a free body diagram so the constraints would have to be replaced with their reaction loads)

A. turn on Inertia relief in your analysis definition.  This will account for small numerical discrepancies that cause rotation.

B. use skunks spring to arrest these small forces.

 

I believe the reason it did not error out as underconstrained may be because of the gravity load you applied, but I did not test this theory.  I say this because inertia relief is also a type of automatic gravity load.

 

-regards

Re: Shaft FEA simulation torque and constraints

Actually, the applied input torques always generate stresses in the shaft, meaning they're being applied by the software. I will  try anyway to apply the input torques to volume regions.

I don't want to use the "inertia relief" feature because the shaft is subjected to gravity and, most importantly, there are radial loads which are not balanced (left and right torque comes from belts, hence a radial load is generated. The central gear as well has a radial load to transmit torque)

 

What do you mean by "In effect the full 20000 ft-lbf was applied to skunks spring instead of the small residual"?

 

Thank you

Re: Shaft FEA simulation torque and constraints

I think I found the issue.  If the spring is too weak it does not work.  The problem was that it is such a large heavy part, the residuals are higher than expected.

 

If I use this property and Skunks spring, the results are great.

 

shaft2.JPG

 

 

To see the residuals try Loads - review total load and look at the tiny errors.

For example...

 

 shaft1.JPG

 

 

Also, I have some concern about your constraints not allowing bending.  Maybe the bearings are not so perfect as that.  Skunks has an example with shafts that can bend at their bearings.  One of us will probably post a link to it.

 

This article about hinges by skunks

And This article on a shaft in housing by skunks

Re: Shaft FEA simulation torque and constraints

???

loading.JPG

Re: Shaft FEA simulation torque and constraints

Yes, your model was correct.

Maybe there was confusion because dnogas model has two separate 1000 loads (each end) and you combined two ends into one.

dnogas model still needs +2000.  yours needs +1000.  The models are different geometry and units anyhow and really just the spring was the "trick" to create truly static to stop the 0.683032 MX residual.

 

shaft3.JPG

 

 

Re: Shaft FEA simulation torque and constraints

Skunks, I apologize. Your torque was correct! I didn't see you applied it on both sides of the shaft as one load.

I think you got the solution. 

It is good to share that under the tab Loads->Load Resultant->It is possible to select multiple loads and compute the resultant. In this case it is particularly useful to select all loads and see how much is the "unbalanced" torque.

 

I still have to play with the model and adjust the spring properties. As a different approach, I'm thinking to apply an additional torque to balance the small residual.

 

Re: Shaft FEA simulation torque and constraints

Thank you for sharing the 2 links, good to know.