cancel
Showing results for 
Search instead for 
Did you mean: 
cancel
Showing results for 
Search instead for 
Did you mean: 

ASSEMBLY SURFACES REQUIRED

ptc-593619
Newbie

ASSEMBLY SURFACES REQUIRED

I am having a senior moment. I have a small assembly (2 parts only) that
I want to use as a cutout within a larger part. Normally I would use
"Publish Geom" and "Copy geom from another model". However, I am having
difficulties because ProE keeps telling me I can only pick from "the
target model"! Does anyone have any idea how I can get the geometry into
the part model?
I'm using WF3.0 M160 still...........

This thread is inactive and closed by the PTC Community Management Team. If you would like to provide a reply and re-open this thread, please notify the moderator and reference the thread. You may also use "Start a topic" button to ask a new question. Please be sure to include what version of the PTC product you are using so another community member knowledgeable about your version may be able to assist.
9 REPLIES 9

RE: ASSEMBLY SURFACES REQUIRED

Pick in the window where the Pub Geom is located....?


I assume you have created the Pub.

ASSEMBLY SURFACES REQUIRED

It would seem that further clarification is required. The small two part
assembly consists of two nominal sized blanks. These are joined together
and then a rotated cut (in the assembly) gives the finished size. This
assembly is then used as a cut out in a third blank. The two parts used
to be one and it was simple to do a PUB GEOM - COPY GEOM to get the
cut-out. Now with the assembly I cannot get a PUB GEOM of both parts to
use.
I have a suggestion to go back to the tried and tested MERGE - CUTOUT
assembly method and I'm trying that now. Further suggestions will be
gratefully received!

Richard

ASSEMBLY SURFACES REQUIRED

How about this...

In part one, make a copy surface of the area to be cut out. Do the same thing for part number two. Next, go to the assembly and make a copy of the surface from part one and from part two. Use the surface copies from the two base parts to create a cut (use quilt) in the assembly.

Bob

RE: ASSEMBLY SURFACES REQUIRED

If you are lookingto do an assembly cut then you havea fewchoices:


1. use the Pub Geom method but create a surface feature instead of a solid feature. Copy the Pub in and then use it to "cut out" the desired void. You cannot copy in a solid and then use it for anything excepta positive feature.


2. Use the Master/Merge then cut out the void in assembly mode. Merge by reference if you want it to update.


3. You can copy surfs from parts as Bob sugestedbut make certain it all updates with a link into an assembly. No sense going to all the trouble to get one shot at it.

ASSEMBLY SURFACES REQUIRED

Regarding #3.

As long as you regenerate the assembly after you make any changes in the two base parts, the surface cuts will propagate and update as well.

Bob

Answer of sorts - ASSEMBLY SURFACES REQUIRED

Paul gave me the direction for what is admittedly a "work around"!

In the assembly make a copy/paste of the solid surfaces in one of the
two parts. Using this quilt, make a published geom for future use. Do
the same for the second part.

In the part to have the cutout done to it, bring in Copy Geom using the
published geom one and do the same using the published geom two. Perform
the cut out for each Copy Geom.

It would seem that everything has to be done twice but it does give me
what I want. I must admit that I was under the impression that you could
do a published Goem in an assembly but it seems that an assembly cut
complicates the action somewhat!

Thanks for all the contributions,

Richard

ASSEMBLY SURFACES REQUIRED

Mr. Bob Schwerdlin,



That sounds like the way to do it. Somehow there needs to be a part inserted into the assembly that resembles the cut. OR the feature needs to be reproduced in the assembly as an assembly cut. It sounds to me like it would be “best” to accomplish this/these cut(s) in stages.



Michael P. Locascio


ASSEMBLY SURFACES REQUIRED

That's a good point!


ASSEMBLY SURFACES REQUIRED

Assembly cuts are very "heavy" features, but surface copies from the parent parts and then copy the surfaces to the final part and create the cut in the child parts from the copied surfaces are light weight and quick.
Announcements