Annotation display for hole features

[sfinke]

So if I create a threaded hole feature I can see the hole callout on screen giving me the details of the  that hole feature.

BUT

If I create a counter-bored hole feature I get no hole call out.

Why is this? If this is a setting that needs to be adjusted why is it not uniform by default?

[lsrutkowski · Accepted solution]

If you create a hole feature using the hole tool and select a threaded hole, Creo will automatically generate a note based on the .hol file for the thread style you have selected.  If you select the hole tool, but do not use the thread based portion of the tool, a note will not be generated.  Why this is the case, I do not know, but this has been the norm since the hole tool was added to Wildfire.

If you want a counter-bored hole for a screw, you can use the threaded hole portion and select to remove the threads.  This will set the hole to be a clear-hole for the thread size selected (once again, based off of the .hol file for the selected thread type).  However, by default, the note for the threaded holes leave a lot to be desired.  There are several threads already on the forums here that detail how you can expand the tables into something more useful (I recommend correcting the mistakes that exist in some of the diameters to start with).

Calling out Counter bores in Drawings.

Re: Dimensioning holes/creo2.0

Counterbore/Countersink hole Notes on Drawing.

Creo 2.0 Help Center on Hole Tables: http://support.ptc.com/cs/help/creo_hc/creo20_hc/index.jspx?id=hole_tables_about&action=show

[sfinke]

Thanks.

If you select the hole tool, but do not use the thread based portion of the tool, a note will not be generated.  Why this is the case, I do not know, but this has been the norm since the hole tool was added to Wildfire.

Sounds like a pretty big flaw if you ask me.

[cmoreno]

Pretty standard for this software if you ask me. Its riddled with flaws and inconsistencies and frustrations to make you pull your hair out. Really feel creo is a russian plot to undermine american productivity.

[MikeMarcoux]

When we had some downtime, we went through all of our standard *.hol files and changed the default callout to standardize them.  Took a little bit of work and testing, but if you focus on the ones you need initially, it's a good 80/20 solution. 

[anthonyws]

Creo is full of this half baked nonsense. The effort to set up some parameters and configurations (akin to coding) is not worth the time. Just create a note. sadly there is no parametric functionality however. so editing a hole size/profile results in outdated drawing that need careful review and editing. Total productivity killer

[Shumayal]

I totally agree. The more I use CREO, the more I miss SolidWorks.

[anthonyws]

I have resorted to putting common hole callouts as text files in onenote (next to my cheat sheets for syntax for parameters such a mass: &pro_mp_mass or &mass:FID_xx and various other relations and functions that I can never remember). Then copy-paste into a leader note. Sadly there is no parametric relationship. Again, wasting the horsepower of such a program. 

[pausob]

For sake of completeness, I'm noting that at some point since 2015 (it is there in Creo 10), standardized notes can specified and automatically attached to the "simple" type of holes:

To be fair, the out-of-the-box hole format remains somewhat awful looking, but it can be customized to fit your standards.

[RaphMORIN]

Yes but it doesn't support counterbore or countersink holes. I'm also wondering if we can customize the number of digits.

[pausob]

Yes, out of the box it doesn't, but you can customize the DEFAULT_CALLOUT_FORMAT_DATA table in the hole files simple_drilled.hol and simple_flat.hol

For illustration:

The number of digits can be controlled by the "standard" method of appending the [.n] to the &parameter callout where n is the # of decimal places.  For example above, if my callout definition was &DIAMETER[.1] then note would show Ø0.5 instead of Ø0.500

[anthonyws]

Thank you for this.

Baffling that this is not the default setting.

Looks fiddly but doable. Where would this table be found?

[anthonyws]

Thank you.

Baffling that this is not the default setting.

Looks fiddly but doable. Where would this table be found?

[pausob]

The system .hol files are in the folder

...\Creo 10.0.5.0\Common Files\text\hole

The config.pro option

hole_parameter_file_path lets you define your own location for the .hol files

Note this is documented in the on-line help.

[anthonyws]

Thanks.

Looking forward to making this work.

[RaphMORIN]

Hi, thanks for the tip. I had already tried to customise these hole notes but it wasn't working. I just reviewed my files and notice I had an exclamation mark at the beginning of each line (don't know why) making them comments only ! 😏