Changing component parameter "linenumber" for all instances

[CS_10428158]

I have an assembly that is broken into several different simplified representations.  I want to use a BOM table in my drawing for consistent balloon numbering.

The best way I see to do that is to use a component parameter "LINENUMBER" in an assembly that will store the line number for a bom table in every instance simplified reps.  

I've entered Linenumber as a component parameter for a few components, but a problem I run into is that when I have instances of hardware I have to enter this parameter individually for all the hundreds of screws and washers.  

Is there a way for me to enter the component parameter for all instances of a component without having to work with Windchill?

Creo 7.0.7.0

[MartinHanak]

Hi,

you can use trail file to create component parameters and set their values.

comp_par.zip

• contains test data set used in video

comp_par.mp4

• shows my "procedure"
• 1st part of video shows how to create parameter manually
• 2nd part of video shows how to create parameters using generated trail file

Note: If you have some programming knowledge you will be able to create trail file generator.

[MartinHanak]

trail file generator

• you can use Excel functionality to generate trail file
• download and unzip comp_par_trail_generator.zip

comp_par_trail_generator.xlsx

• contains trail file generator

comp_par_trail_generator_NOTES.docx & comp_par_trail_generator.mp4

• information how to use Excel file

EDIT: instead of Word it is possible to use Wordpad

[CS_10428158]

I see that you are using the feature ID to identify each component.  If I have 30 screws how do I add a component parameter to all of them?  Do I need to collect all 30 feature id's?  

This doesn't seem practical.

How can I select all components of the same name and add the same component parameter and value.  For example I want to make all the screws have linenumber value "2" that way when I have drawing BOM they are not separate but merged quantity?

[MartinHanak · Accepted solution]

---

@CS_10428158 wrote:

I see that you are using the feature ID to identify each component.  If I have 30 screws how do I add a component parameter to all of them?  Do I need to collect all 30 feature id's?  

This doesn't seem practical.

How can I select all components of the same name and add the same component parameter and value.  For example I want to make all the screws have linenumber value "2" that way when I have drawing BOM they are not separate but merged quantity?

---

Hi,

Q: If I have 30 screws how do I add a component parameter to all of them?   For example I want to make all the screws have linenumber value "2.

A: See uploaded video. It shows procedure mentioned in https://www.mcadcentral.com/threads/component-parameters-in-assembly.9221/ discussion.

EDIT: Press right mouse button to display context menu after selecting components.

[CS_10428158]

This is great! This allows me to add a parameter to all the components of the same name.  It seems there is a difference in selecting as a component vs assembly member.

Is there any way to do this kind of selection from the model tree?  

[MartinHanak]

Hi,

I am sorry I do not know what you are asking for.

[CS_10428158]

In the model tree there is a search bar.  However, if I try selecting components through this search bar and select parameters it takes me to the part parameters instead of component parameters.  I'm just wondering if there is a way to change this through a setting or filter.