Is there a way to import STEP files so that they can be modified?

[NESCFFR]

Hello, recently I am using CREO parametric 11 for a project, and I have found useful STEP files online that I need. However, when importing they seem to lose many features and even the ability to edit them in basic ways. Is there a way to import STEP files so that they can be edited?

[kdirth]

There are many settings in the import Details that can help.  The one that seems to make the most difference is Model Accuracy.  Setting Model Accuracy to External helps ensure the math behind the step works.  I have also been told to change the part accuracy to that of the import, if known, before importing it.

Not all step files can be imported fully intact and some repair with IDD will be needed.

As far as editing, the import is "dumb" and cannot be edited like a native file.  Flexible modeling can allow you to make some changes to the imported model.

[Blue_Oranges]

I've had luck with this parameter setting in my config.pro file: 

intf3d_in_as_part yes

Why STEP file import to .prt file functionality doesn't already work out of the box, we'll never know... one of the many complaints myself and my coworkers have with this cluster of a CAD package. Just typical Creo. 

Anyways, hope this helps!

[KenFarley]

The setting intf3d_in_as_part is a hidden option. It tells Creo to import any STEP file you read in as a part file, even if it is an assembly. This can cause crashes, and will often result in models that are just surfaces, not solid bodies. This is because an assembly STEP file will contain geometric data for parts that overlap each other, etc. Interfering surfaces and such will prevent Creo from making a manifold solid.

If you're importing a file and it is an assembly, you always have the option of specifying that it be read in as a part on a case by case basis, if that's the source of the troubles.