My company is trying to create drawings that are easier for our assembly line to understand. This means creating a drawing more like a step by step instructions. This means breaking up the complicated assembly into separate stages and we are doing this by creating simplified reps for each stage of assembly. However, we need an easy way to assign BOM balloons to each of the simplified rep views. Currently we assign a separate BOM table to each view and fix the index numbers to the same index number in the master rep BOM. This is very time consuming and there is a risk of mistakes.
I had two ideas as a solution, but I cannot get either to work.
Idea 1: Create BOM table with multiple &rpt.qty columns with each column assigned to a different stage. This works well because it shows all of the stages and the quantity of pieces at each, however, we cannot attach BOM balloons to any views because of the following error: "BOM Balloons are not supported for regions with multiple models."
Idea 2: Create a component parameter for each component in the assembly and call out this parameter in a custom balloon in each of the simp rep boms. I have been able to do this, but it seems very time consuming still because I have to individually create the parameter with each component. Is there a way that I can create a component parameter for all of my components and the then edit the parameter in the model tree.
Can someone help me find a work around?
First, if you haven't already, I would suggest you upvote this idea: Allow BOM Ballons from Master Rep Repeat Region to be displayed on Simplified Reps
We have solved this problem a couple of ways. One is what you mentioned - fixing the index on multiple regions.
The second is to change your balloons to be custom balloons. We have balloons that instead of calling out the find number call out the actual part number.
The third solution is to exploit a big in Creo that has been around for multiple releases. Hopefully they don't fix this, but no guarantees going forward. Creo won't let you move a balloon from a master rep view to a simplified rep view using the move item to view command. It will give you the error you mentioned. However, if you right click and choose "Edit attachment" and the change the selection from change ref to same ref, it will move the balloon to a view with a different rep. It can be a little tricky. The way it works is if you hover over the same line, surface, etc that the balloon is currently pointing to on your master view then the balloon will jump and point to the same line, surface, etc on any over view.
You might also want to look into Pro/Process. Its called "Process Plan" or "Process Planning" now. It's a part of the Advanced Assembly Extension.
As Christopher said, If you have Advanced Assembly, you want to look at the Process Planning functionality. It is made for this exact scenario and makes this quite easy.
I'd look at it first, if you have it it will save you a lot of effort.
It's a year later but this might still help! I've struggled with this for a while now and I think I've figured out a workaround. We have the same problem about trying to break down our assembly drawings into stages for instructive purposes and simplified reps just don't have the right options. I've ended up creating layers and hiding in the view then saving status to do it. This will allow you to hide components without creating a simplified rep. You can also select entire groups and patterns to hide rather than having to select each individual component. The BOM balloons can then be created by view (and it will automatically exclude the parts that are hidden). I've so far found it hasn't caused any problems but it's still early days!
My solution is as follows:
Hope that helps! Let me know if you find any issues as I've only just started using this method.
What version and datecode of Creo are you using? I just tried this in Creo 4 and it still works. If they haven't fixed it in Creo 4 I find it hard to believe they fixed it somewhere else.
Definitely Possible. I have Creo 2 M150 and it works fine. As I mentioned in the first post, it can be tricky .... you have to move you mouse over the same line / surface that the leader is attached to in the master rep view. It can help to change the reference attachment in the master view to a line / surface that can be easily seen in the rep view prior to choosing the same ref option if you are still having trouble.
Make sure you choose the "same ref" in the dialog box.
I just found out that it works only with using a line placement not a surface. Then it is possible to Edit Attachment in a new view again.
Thank you. Nice trick