I have a client who with creo 7 cannot change from relative to absolute precision.
I tried to activate the enable_assolute_accuracy entry for it but it is no longer valid.
Do you know if there is a new entry, or how to change a model from relative to absolute?
It seems that the menu in the properties makes me change only the values but not change the method.
The options to enable absolute accuracy have been removed in 7.0. Default for new models in 7.0 is absolute accuracy (using a start part uses the defined accuracy in the start part). Not sure why you are not being allowed to change from relative to absolute. I am able to change accuracy of old parts. Though most of the time complex parts tend to fail when changing to absolute.
I am very interested as to the issues you have experienced, as so far I have only from other users that absolute accuracy is very stable in Creo7 and causes less failures. What you are saying though is truely a show stopper and may put a stop to us switching to Abs accuracy for any parts at our company. Can you elaborate on how your models are failing when going from Relative to Absolute Accuracy?
The problem is only with part models and has always been a problem as far as I know. I know I have tried it in Creo 2.0 with the same issues. I have not submitted a case to PTC for this issue.
The issues I have seen are only with converting models to absolute accuracy and using inheritance features. You do not need to convert old models to start using absolute accuracy. Both relative and absolute models will live happily together in an assembly.
Absolute accuracy works very well when a part is started with absolute accuracy. I work with a lot of contoured surfaces (for seat cushions) and complex shapes (for stamped sheetmetal and plastics). Models tend to lose references and features fail to complete features when converting. We just do not convert old models to absolute accuracy.
We are working in metric and currently use and accuracy of 0.001 mm. I have not experienced any issues that I can attribute to absolute accuracy in creating new models except when using inheritance features.
When creating a new model and trying to inherit a model made with relative accuracy, it will not work. I always have to change the new model to relative to get an inheritance to work when the inherited model is relative.
Our start models have all been converted to absolute and our old models are not being converted. There have been no issues with using both relative and absolute other than using inheritance features. Our mold maker is much happier with the absolute models because he usually remodeled our parts to get the model quality he wanted.
Hope this helps.
I have never encountered a version dependent issue with accuracy conversion in Pro/E or Creo Parametric. I doubt any of the issues you are describing are release dependent. Converting from relative to absolute has always been fraught with failures. I have had to correct this deficiency in existing designs and often it is faster for me to rebuild the model than to attempt the conversion to absolute accuracy.
Some critical points regarding your issues.
You should always use absolute accuracy for your designs.
If you are working on structural steel parts that have tolerances of +/- 0.1" don't set the absolute accuracy to 1 nanometer. In general I have found that setting the accuracy one order of magnitude smaller than process resolution works well.
As shown by @kdirth Creo 7 still supports relative accuracy. The config option enable_assolute_accuracy is not valid in Creo 7+. Creo 7+ uses absolute accuracy by default. If you have legacy models or start parts that use relative accuracy they are still supported.
You can change the accuracy by the following UI selections: