Michael,
There are many times that I need to send out an iges file of my designs for
cosmetic surface "approval" from the ID house, or Client who may not have
Pro/E. In this case, I want to send the master surface shape, with a few
projected curves on surface for visual reference, however, (in my models
that can be upwords of several hundred features) I don't want to check the
default "datum curves and points" button because that will include All
construction curves and points from my model and creates a visual mess for
the receiver of the files. So, Here is the method I use.
1) export your solid (or surface) model as you normally would.
2) set the curve features that you want to include to a specific layer.
(important note: make sure that these features are the only thing on that
layer, and that these features are removed from all other layers)
3) export these specific curves using the following method:
a) check the "datum curves and points" box
b) un-check all other boxes
c) Select the "customize layers" button
d) in the "Choose Layers" box, the one layer you want should be set
to "show", all others should be set to "skip"
e) OK, and OK. (export of curves should now be complete)
4) open a new part. Import your solid (or surface) model, then import
your curve model.
(you now have a stand alone model that shows everything you need,
and nothing you don't)
5) Export this new model selecting the "Solids" box, and the "datum
curves and points" box. and your ready to send the file.
This method is a lot of extra work, but it gets the job done for me.
While I'm on the subject... I'll also say that it would be nice if PTC
would add some functionality to this "Export" pop up allowing us to select
individual curve "entities" to include in the export. (Similar to the way
it allows us to select specific "quilts", or similar to the way the
"External Copy Geom" feature allows us to select specific "entities")
Good Luck
Bernie
Bernie Gruman
Owner / Designer / Builder
www.GrumanCreations.com
