Feature I.D. in Notes

[msteis]

Would someone here be able to school me on this. This is a note on an assembly drawing that refers back to the feature i.d. in a particular part in the assembly. I think I know where to find the feature i.d.'s, but haven't figured out how to refer back to the correct part. Could someone dissect this note for me?

Thanks,

Matt

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[Patriot_1776]

The "&d26" is the dimension number, the ":52" is the conponent number in the assembly. Neither of those is the actual feature id #.

Here's a good list for using parameters in dwgs.

[msteis]

Thanks a lot for the list Frank. It will really help me out. I'm still stuck on where to look to find the component number for the note though.

Thanks,

Matt

[Dale_Rosema]

The componenet numbers are not always the same. They can vary depending upon the drawing in which they are located. Widget ABC maybe componenet number 123 in drawing DEF, but might be component 456 in drawing GHJ. If the drawing is of a part and not an assembly, and you are looking to replicate the note in several drawings (instances in a family table), you can paste the note in the drawing without the component number and is assumes the active component. Again that is based on a single component drawing and not an assembly drawing.

[Patriot_1776]

Very true, I forgot to mention that. It varies from assy to assy and/or dwg to dwg. You can show a dimension from a part in the dwg, do a switch dimensions, and it will show the ":XX" number so you can use that.

[bleech]

I know this posting is a year old but other users might like little background information concerning the ":XX" number - this is referred to by PTC as the "Session ID" or "runtime" number for every object in session. The number varies based on how many objects are in session and the sequence you retrieved the objects in - so basically you can never predict what the digits will be, you have to find out what they are on your own each time you need them.

I like the show dim / switch dim method because it's quick and the number appears in the Graphics window and is quite easy to read.

PTC provides access to this number in their menus by: TOOLS > RELATIONS > SHOW > SESSION ID . After you've chosen the object you're interested in the system responds with a message in the message area with something like this:

"Model xxxxx has Session id 672."

Unfortunately the message window is not as convenient and easy to read as the show dim / switch dim method. The menu method does, however, give you some options in how to chose the object you're after that you might find useful such as the Assembly and Skeleton selections which might be a little trickier to deal with using the show dim / switch dim method.

[TomD.inPDX]

The session ID's are not very helpful. You can query them but it is a painful interface. Probably easier to search for a particular one. The other interesting thing is that duplicate parts have the same session ID but internally, the drawing has to know which instance is being called. In other words, we are not being presented with sufficient information to know exactly where these annotation features are called from. The best I can think to do is to open the model, highlight the feature, and "find in model tree" with the RMB. I'm sure there are other ways but this isn't too bad.