How to hide a parameter value in drawing

[thlavinka]

Hello,

I have several model parameters that are shown in drawing BOM. Two of them are raw material dimensions and a standard (norm)

I would need to hide/dont show a value of the dimension in drawing supposing that the parameter standard is not empty.

Thanks in advance

Tom

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[RaphMORIN · Accepted solution]

You should manage to do this with relations in you parts. Something such as :

if standard == ""

     dimensions = ""

else

     dimensions = "what ever you want"

endif

[thlavinka]

Can i ask for one more help?

I would like add next following relation to a subasm drawing:

if asm.mbr.nazev == "SVARENEC"

     asm.mbr.norma = ""

else

     asm.mbr.norma = &sheet_number

endif

where asm.mbr.nazev is a name of the subasm/part in BOM. In case of a subassembly the name is always "SVARENEC"

I would like to make a relation to have in the bom collumn a sheet number in case of subasm (svarenec) or a standard (DIN....) at parts in the same collumn.

It does not work....

Thanks for help

Tom

[RaphMORIN]

The syntax asm.mbr.something is used only in the table reports. For you relation you must write it with parameters like this for example :

if nazev == "SVARENEC"

     norma =""

else

     norma = &sheet_number

endif

[thlavinka]

OK, and this relation should be in drawing bom table or each model of the subasm?

I tried both ways with no success

thanks

[James62]

Not sure i understand the problem, but first, make sure you get rid of the ampersand (&). Second, make sure you get rid of the dots in the repeat region param names and replace them with underscorers (_).

if asm_mbr_nazev == "SVARENEC"

    asm_mbr_norma = ""

else

    asm_mbr_norma = sheet_number

endif

Third, depending on what version of Creo/Pro/E you run make sure all the parameters that are used, such as ASM_MBR_NAZEV, ASM_MBR_NORMA, SHEET_NUMBER are present in the repeat region parameter list.

[thlavinka]

It works....., thanks a lot