Hi Creo users,
I have a 3D model part and I have created a sectional view (still in part mode i.e. View- Section- X Direction).
Can I create a sketch (.sec) out of the sectional view I created above?
Your input would be appreciated.
Solved! Go to Solution.
You can create a curve from a section and project the contour (or part of it) into a sketch. And if you handle the references right, it will update the geometry right. To provide the curves from one part to another, you can use copied curves or better copy geometry. It depends on top down strategy or independent usage.
Hope that helps
Thank you for the reply.
I will have to think about what you wrote a bit more. It does not seem to be a straight forward thing from what you wrote.
Ok I got the contour/profile projected on a plane. Now how do I save the projection as a sketch .sec? Googling is not helping at all. I am still in 3D part mode.
Simple. After projecting the contour, while you're still in Sketcher, select File > Save > Save a Copy and save the sketch file on disk. Do not exit the Sketcher or you'll save the copy of the model instead of the sketch.
Thank you for the response.
See pic attached.
Thank you Lukas.
The issue I was having with your solution is while I was in sketch mode, and using the project tool, I couldn't activate the curve that was created earlier. Even the proposed solution by Cormack87 i.e didn't do it.
What needed to do done was to "Project-> Loop" then instead of selecting curve from the model tree, just select the section individually from the 3D-model.
Selecting the curve from the model tree should have done the same job, but seems Creo is fussy about it.
Thank you for pointing me to the right direction. Much appreciated.
Assuming the plane you wish to sketch on is the same plane that is creating the x-section, could you not use the Intersect tool to create intersection curve using the plane and the body, then once a Sketch is created on the plane use Project > Loop selecting the curve generated from the Intersect?
Thank you Cormack,
What I had to do is instead Project -> Loop and select the curve (from the model tree) , I had to select the cross section from the 3D model instead.
Thank you for your suggestion.