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R
rmuller10-Marble
10-Marble
July 2, 2015
Solved

Pre Set parts so they dont show on BOM when generated.

  • July 2, 2015
  • 1 reply
  • 1914 views

Hi Guys,

 

is there a way you can set part during modelling or when assembling so it doesn't show on BOM when generated in drawing? I mean I have plenty of parts which are not good in BOM and I have to filter them out one by one. For example air cylinder is made of mounting bracket, main body and slider. On BOM I only need assembly name and bracket. I would like to be able to preselect parts which I don't want to appear on BOM before I generate BOM table.

 

Hopefully you can get what I am trying to explain here.

 

Thanks.


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Best answer by TomU

It is a repeat region filter, and I had the syntax wrong.  It should be &ASM.MBR.STOCKLIST != NO

Sample drawing and assembly with two drawings is attached. (Creo 3)  Open prt0002 and change the STOCKLIST parameter from 'NO' to 'YES' to see it reappear on the BOM.

1 reply

T
23-Emerald IV
TomU23-Emerald IV
23-Emerald IV
July 2, 2015

One approach is to add a parameter to your models and then filter on that parameter in the BOM.  In the past we used a "STOCKLIST" (yes/no) parameter.  In the repeat region we had a filter that said &asm.mbr.STOCKLIST <> NO.  (This way you don't exclude things that are missing this parameter.)  If you add this to your start parts, you can even preset the value.  (Assemblies == NO and Parts == Yes)

    R
    rmuller10-MarbleAuthor
    10-Marble
    July 2, 2015

    Tom, thank you for your help.

    I am not sure of one thing. I can add YES/NO parameter to my start part. I have a BOM table which has Index, Part Number, Description, Qty and Vendor in it. Should I add this &asm.mbr.STOCKLIST <> NO as another column? Or is it filter rule I need to add? I tried and to add it exactly as written and it gives me some error.

    Do you know off some other solutions to this? I like the parameter way anyway.

    T
    23-Emerald IV
    TomU23-Emerald IVAnswer
    23-Emerald IV
    July 2, 2015

    It is a repeat region filter, and I had the syntax wrong.  It should be &ASM.MBR.STOCKLIST != NO

    Sample drawing and assembly with two drawings is attached. (Creo 3)  Open prt0002 and change the STOCKLIST parameter from 'NO' to 'YES' to see it reappear on the BOM.

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