SUMMARY &model_name and solution for many part update through modelcheck.
It has been an interesting thread today and thank you everyone for your input. I took pieces from all and came up with these conclusions and solution.
It is known that adding a note with &custom_parameter_name:att will place the parameter text in the note based to the attachment point. Thanks, Doug for pointing this tidbit out.
It is known that if you want to use the system parameter &model_name in a note you must include the system ID in the format &model_name:ID# In order to find the correct system ID Ted supplied this solution.
You can show a dimension from the component you're searching for the ID for. Once the dimension is on the print, toggle the "switch dimensions" button and it should show the dimension name followed by the ID (example :2). In your note, use &model_name:2 and it'll pull the model name from that component. After you find the ID, you can then erase the dimension.
Additionally you can use Martin's Solution
The session id may be obtained thru the relations window in a drawing.
TOOLS
RELATIONS
"look in" PART
select a part
SHOW
SESSION ID
PART
start selecting parts and write down the numbers on a paper copy of the same drawing.
Either way both can be tedious and prone to mistakes as you are manually doing something
My Solution:
I knew that adding a parameter (NAME) to my parts would allow me to put note in very simply with the :att method so I had to come up with a way to add the parameter which did not come to me until Dustin suggested adding a relation NAME=rel_model_name. What is not apparent is that if you add a relation like this it automatically adds NAME as a parameter from the relation input screen. I also did not know rel_model_name would get me the same info as system parameter &model_name. So I set off to use modelcheck to add this relation automatically to my parts.
STEPS I performed
1. Opened full assembly with 200+ parts
2. Went to menu Tools / Configure ModelCheck
3. Click + on Configuration settings
4. Click + on check files
5. Click Create new file or see if default_checks.mch opens
6. Click Add row button
7. From Pull down box under check name scroll down to RELATION_MISS set options YNEW Interact W
8. Click save as button type in file name default_checks.mch let it over write current one
9. Click on + on Start files
10. Click on nostart.mcs if not found create new file
11. Click on Add row button
12. Click on highlighted space in the Check Name column
13. Click on the word Part in the lower window section then click on Select item type to the left of that
14. A new line will pop up below your cursor click on Accuracy and scroll down to Relation
15. Value(Alphabetic) appears type in YOUR RELATION on the right in my case it was NAME=rel_model_name
16. Click back on Value (Alphabetic) then click the Add item button and you should see the line appear in the upper window.
17. Click Save as button and type in filename notart.mcs let it over write current one.
18. SIDE NOTE if you want to add other parameters to your parts you can do that at this time also see jpg below for what adding parameter looks like.
19. Close that window
20. Go to menu Analysis/ModelCheck/ModelCheck Interactive
21. Pick All Levels from legacy pop up menu wait for it to go through all components.
22. Now you should have a parameter in each part called NAME and the value should be equal to the part name. Additionally if you added other parameters all parts will now have them too.
Please note our new address below!
Thanks,
Ron Rich
DIRECTOR of MECHANICAL SYSTEMS
smartshape
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