As long as it is a complete quilt, you can solidify the whole thing (using the solidify command). You need to select the quilt, not the import feature itself, and not a single surface, and then use the command.
If it came in as surfaces, odds are it is because there are missing surface patches, hence why it got exported/imported not solid. You could try to fix missing surface patches using the Import Data Doctor (IDD), but that can be awefully time sonsuming.
It could also be that whoever did the export had it configured to send it as surfaces; you could ask them to send it as a solid and see if they can help.
Another thing to try, make sure you imported as a part. If you import it as an assembly (even in a flat file structure), it may come in as surfaces, too.
The Find Tool can also find any of these "pink" edges that need to be corrected, in case they're not easily visible to the naked eye.
Look for: Edge, Look by: Edge, Attribute tab > Type radio button > Value menu > One-sided
In Reply to Bob Schwerdlin:
I’m partially color blind (thanks, mom). I can see all colors, just like you, however I cannot always discern what color family (range, hue etc.) I’m looking at. For me, I ALWAYS use the “pre-wildfire” color scheme with a black background. When dealing with surfaces, which I use daily, the pre-wildfire colors show up as, Magenta and Yellow. For me, that makes it easy(er) to spot the guilty offender.
From time to time, I have also removed small problemed surfaces and just patched them with a boundary blend or some other method, just to make the quilt “water tight”, so that I could solidify the model. Although I have done it this way in the past, I first try to fix it in, Import Data Doctor. I have had varying degrees of success with IDD, but like was previously mentioned, IDD is not very intuitive and there is very little in the way of assistance available on the internet. It’s mostly hit or miss, but it is worth a try. Sometimes you get terrific results.
Something else you may want to look at is… are there any small corner or sharp intersecting surfaces that twist or overlap at ANY point in the model? If you do, then you will NEVER be able to solidify the model. You will be forced to clean up the file with IDD, or perhaps the file you received from your customer/vendor has a problem and you might need to go back to them and have them correct the problem and re-send the file.
At the company I work for, we are fortunate to have one seat of SolidWorks, one seat of UG and several seats of Inventor, along with many seats of Creo. We have found that importing the offending files into SW, UG or Inventor and then exporting the file as a “new” STEP or x_t file or even as a CATIA file and re-reading the new file into Pro/E – Creo will sometimes generate a solid file that we can work with. Many times, the competitor CAD programs do a better job translating STEP and IGES files than does Creo. One side note, the CATIA translator in Creo works very well and will almost always import CATIA files as solids on the first shot.
Sr. Design Engineer
2900 Dukane Dr.
St. Charles, IL 60174 USA
I'm presenting on Import Data Doctor at PTC Live in June.
If you have a chance stop by.
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