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It appears that this may not be possible, but has anyone successfully copied a feature out of one part by editing the pro/program, copying the feature, and then pasting it into a new part?
When I try and do this it complains saying that there is no internal feature ID that matches the one that I copied and pasted from another part.
I understand that there are more convenient ways to copy and past features, but for my own reasons if possible I would like to do it using Pro/Program. I know that Pro/Program can read in a design "from file" which made me think that this might have been possible. Maybe it can only change existing features though and not add new ones.
Solved! Go to Solution.
In theory you should be able to step through the model using the model player for all features of interest. You can record this as a trail file. Trail files are not easy to debug but if you use these config options then it is workable IME.
CONTINUE_FROM_OOS TRUE
set_trail_single_step yes
To explain a little bit further: ultimately what I would like is the ability to create a Creo part using a text file.
I am going to assume from the responses that the only way to re-create a part from using a plain text file would be to use one of the toolkits.
It is possible to generate a trail file (text) and then run that to create a part. In practice it is a bit tricky and a pain to debug but it is possible.
In my experience trail files are prone to causing Pro/Exits and or just don't work after a couple of steps. They can be useful for some things but not for anything with a lot of steps.
In my particular case, I have a preexisting CAD model that I want to re-create (with a text file) and the trail file that was generated when it was created is long gone. Not only that but it has a bunch of iterations.
In theory you should be able to step through the model using the model player for all features of interest. You can record this as a trail file. Trail files are not easy to debug but if you use these config options then it is workable IME.
CONTINUE_FROM_OOS TRUE
set_trail_single_step yes
Thanks for the reminder about model player. Its been a long time since I played with that. I will this as the solution as I think it is the best answer I am going to get that isn't Pro/Toolkit.
Just recently I was able to use a trail file to generate hundreds of DXF files, by doing the things I wanted to repeat (all the stuff that I wanted to set for each DXF, like version and such) with one file, then duplicating the sequence of commands while merging in a list of all the files I wanted to process. It worked nicely, once I figured out the syntax of the trail file and what was important.
It's not easy, by any means, and mistakes cause Creo to crash ungracefully, but once I got it working it saved me from hours of loading in and DXF-ing file after file. You really do need a good text editor, too. "Notepad" or other stone tools of editing will not cut it...
The internal feature ID within a part is unique, so if you are trying to get a feature from another part that is why you are getting that error. Check to see if you can access the session ID within Pro/Program. The session ID is tracked internally for all in session items and this will allow you to identify a feature from another part. The session ID is not persistent (saved with file) and is only valid for in session objects so writing a text file with a session ID will not work unless you can determine session ID on the fly and modify the text file.
Hi,
I am almost sure that Pro/Program can only work with existing features and it is not able to add new ones.