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sl27411-Visitor
1-Visitor
October 11, 2012
Question

move surface (transform) in Creo

  • October 11, 2012
  • 7 replies
  • 5414 views

I am looking for functionallity that used to exist in pre wildfire and wildfire but can't find in creo.


In prewild fire it would be surface operations / transform / move. In Wildfire it was "edit"/ move (rotate, etc)


In Creo 2 - I don't see it !!! For my example, I want to create a copy of a surface and offset it so that I have a duplicate. This use to be so easy, now I just can't find this capability. Very frustrating - I appreciate any help


Scott

7 replies

R
RonGrabau1-Visitor
1-Visitor
October 11, 2012
Still easy, you just need to know the new name. What is hard is that you are jumping from a non-Wildfire version. It has been called offset for years now.

While in the model tab, select your surface that you want to offset. Then in the Edit section pick Offset.

You can always use the search commend. Pick on the spy glass at the top right of the screen. Type in Offset. It will show you where offset is used in the ribbon interface. You just need to know what it is called. In your case it is not

Ronald B. Grabau
HP PDE-IT
Roseville, CA
916-785-3298
-<">mailto:->

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sl27411-VisitorAuthor
1-Visitor
October 11, 2012

I found it... don't want to start an unnecessary thread showing that my impatience with exploring menus is leading me to frustration. Needless to say, that it can in fact be done. I found that you must first select the surfaces of interest (nothing new there) then copy and paste (yes, yes) ....now for the interesting part! ....then you must select this pasted copy and copy it again, THEN you may use paste special (previously grayed out) to transform (move or rotate) and if you are interested, beyond that you may copy the original which leaves the original in place or not which simple leaves you with one moved surface under the options tab. So happy that I could answer myself...

S
sl27411-VisitorAuthor
1-Visitor
October 11, 2012

Thank you for your reply. In fact, offset is a different function from what I was looking for, but I did find what I was trying to do.


Offset is similar to a thicken feature, so a sphere with a 1" radius offset .25" would create a sphere with 1.25".


My objective was to select the that sphere and make a duplilate (say .5") away from it.


I do appreciate your rapid help.

B
BrentDrysdale12-Amethyst
12-Amethyst
October 11, 2012
Hi Scott,

Sort of two parts to your question. One is answered by Ron regarding the
Offset command of a copied surface which we have been using in WF since we
changed from R2001 to WF2. It is not however the same as the old pre WF
Surface Transform Move methodology which I think of as the second part of
the question.

The old method can still be found in Creo 2.0 by having the Search box open
up in the top right (not sure why it is not open as a default) and type in
the word "legacy" without the quotes.

This brings up the old school Menu manager and there you can select
Surface>Transform>Move (with Copy or No Copy) then select your surface and
proceed through the rest of the steps. If you pick Copy then your function
is pretty much the same as the Offset command but if you pick No Copy then
the old transform command really moves that original surface with all its
reference info to a new place. You see the new feature as a Transformed
Surface in the Tree and if it was truly just moved then the icon is a
surface with a dotted arrow to indicate it has moved.
This method could be, and still can, be used as a massively powerful tool
when doing parts that will be tooled with a split line as you still keep
everything that is made from that surface alive without the need to
re-reference it later.

I will send you a small Creo 2.0 part that has just some surfaces using
both methods in it for you to look at.

Hope this helps.


Regards,

*Brent Drysdale*
*Senior Design Engineer*
Tait Communications
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BrentDrysdale12-Amethyst
12-Amethyst
October 11, 2012
Hi Folks,
As a disclaimer I should point out that once I have that Legacy Menu
Manager open and even though I can do this extra stuff with it I have not
found out a way to close it afterwards. Well i have but it is the "get out
of the car and get back into the car" method = close down Creo and open it
back up again. Assuming of course that you saved before getting out of the
car 🙂


Regards,

*Brent Drysdale*
*Senior Design Engineer*
Tait Communications
J
jer3d11-Visitor
1-Visitor
October 11, 2012
To leave legacy mode, in the search menu, type Legacy.

(It's a switch.)


B
BrentDrysdale12-Amethyst
12-Amethyst
October 11, 2012
Thanks to Jered for pointing out the way to get out of Legacy.
I should have figured out something so obvious myself (hint of sarcasm
there directed at myself). Certainly the hope of the little X in the top
right hand corner of the Menu Manager was not useful

There was another thing I did not mention regarding Offset is that it
really does alter the offset surface so that the example of the sphere
being larger is true whereas the Transform>Move is a shift in space
(translation) of the original shape of the surface so the surface does not
change shape as such and this applies whether you move with Copy or No Copy.

All depends on what you want to achieve 🙂


Regards,

*Brent Drysdale*
*Senior Design Engineer*
Tait Communications
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