cancel
Showing results for 
Search instead for 
Did you mean: 
cancel
Showing results for 
Search instead for 
Did you mean: 

Community Tip - You can change your system assigned username to something more personal in your community settings. X

pdf export pen pattern Creo 8.0.5.0

SP_saro
4-Participant

pdf export pen pattern Creo 8.0.5.0

The drawing must be exported as a PDF. We have phanthom and hidden lines in the drawing.

If I set the Pen 3 pattern . it will only accept one Line style.

(pen 3 thickness 0.010 cm; pattern 0.1 0.05 0.025 0.05 cm)

How could different line styles be used? Hidden line and Phanthom line both use Pen 3.

Please assist me in solving this problem.

 

 

 

ACCEPTED SOLUTION

Accepted Solutions


@SP_saro wrote:

if the pattern line is removed, hidden line and the Phanthom line looks good.. but I need a different pattern for the hidden line and the phantom.

 

 


Hi,

so it looks like you do not like default patterns assigned by Creo to hidden and phantom lines.

One possible solution = changing phantom component display. Please play attached video and use uploaded data.

 


Martin Hanák

View solution in original post

10 REPLIES 10

Hi,

what happens when you remove pattern 0.1 0.05 0.025 0.05 cm from pen definition.


Martin Hanák
SP_saro
4-Participant
(To:MartinHanak)

 

PDF Output

issue1.png

 

Drawing

original drawing.png

 

If I can use the pen 3 thickness 0.010 cm; pattern 0.1 0.05 0.025 0.05 cm

Its shows hidden line also in phanthom line style.

 

 

 

Hi,

once again ... remove pattern 0.1 0.05 0.025 0.05 cm from pen definition.


Martin Hanák
SP_saro
4-Participant
(To:MartinHanak)

if the pattern line is removed, hidden line and the Phanthom line looks good.. but I need a different pattern for the hidden line and the phantom.

 

 


@SP_saro wrote:

if the pattern line is removed, hidden line and the Phanthom line looks good.. but I need a different pattern for the hidden line and the phantom.

 

 


Hi,

so it looks like you do not like default patterns assigned by Creo to hidden and phantom lines.

One possible solution = changing phantom component display. Please play attached video and use uploaded data.

 


Martin Hanák
SP_saro
4-Participant
(To:MartinHanak)

Wow, Nice Idea, I can use this option .

If we can change the Pen 1 pattern its not effect geomentry line and etc (below mentioned as Pen 1 line styles?

 

  • Visible geometry
  • Cross-section cutting plane lines: plot as phantom lines
  • Cross-section cutting plane arrows and text
  • Drawing format and boundary
  • Tag text
  • Centerline line font with white color
  • Brown portion of datum planes

Thanks a lot for your workout

 


@SP_saro wrote:

Wow, Nice Idea, I can use this option .

If we can change the Pen 1 pattern its not effect geomentry line and etc (below mentioned as Pen 1 line styles?

 

  • Visible geometry
  • Cross-section cutting plane lines: plot as phantom lines
  • Cross-section cutting plane arrows and text
  • Drawing format and boundary
  • Tag text
  • Centerline line font with white color
  • Brown portion of datum planes

Thanks a lot for your workout

 


Hi,

look into pentable_02.pnt

 

pen 1 thickness 0.010 cm; color 0.5 0.5 0.5; pattern 0.1 0.05 0.025 0.05 cm
pen 3 thickness 0.010 cm; pattern 0.1 0.05 cm
pen 10 thickness 0.050 cm; drawing_color

 

 

pen 10 thickness 0.050 cm; drawing_color

... drawing_color keyword causes that Creo will draw visible geometry by pen 10 instead of default pen 1

 

You can use other keywords to resolve your needs.

 

Notes:

1.] All user colors are drawn by pen 1.

2.] All system colors have assigned their keyword which enables you to assign them specific pen.

https://support.ptc.com/help/creo/creo_pma/r10.0/usascii/index.html#page/data_exchange/interface/Default_Pro_ENGINEER_System_Colors.html

 


Martin Hanák
SP_saro
4-Participant
(To:MartinHanak)

Thank you very much for the clear explaination and your time .

 

SP_saro
4-Participant
(To:MartinHanak)

Hello Martin

 

Your choice to manually adjust the view color in Phantom_hidden_PDF.mp4 results in output PDF phanthom and Hidden line utilising the Pen table.

 

Can we choose a different colour for the phantom line and hidden line details in system color ?

 

Note: In system colour, I only saw only Hidden line color only

 

 


@SP_saro wrote:

Hello Martin

 

Your choice to manually adjust the view color in Phantom_hidden_PDF.mp4 results in output PDF phanthom and Hidden line utilising the Pen table.

 

Can we choose a different colour for the phantom line and hidden line details in system color ?

 

Note: In system colour, I only saw only Hidden line color only

 

 


Hi,

I guess you are asking how to change colors in Creo window.

Hidden Line color:

MartinHanak_0-1688719007811.png

Custom color assigned to phantom components in Drawing mode:

See phantom_hidden_PDF.mp4 video again.

You can select any User-defined color -OR- create new one. AFAIK you cannot set user-defined color as default one for phantom components.

MartinHanak_1-1688719474958.png

 


Martin Hanák
Announcements
NEW Creo+ Topics: Real-time Collaboration


Top Tags