Creating BOM table in Creo Drawing involving sub assemblies components

[MohaSharifi]

I have an assembly model that involves 2 sub-assemblies. When I add automatic BOM table the subassemblies appears in the table, while I need to add a BOM table to the assembly drawing covering all components ( main and sub-assembly).  Can anyone have a solution (BOM of all components and not subassembly names)?

[StephenW]

Your BOM table is set to be "FLAT". You can change to be "RECURSIVE"

Go to the table tab, repeat region, select attributes, select your table, select recursive then done.

[MohaSharifi]

Thanks Stephen

I followed that process and now I have all the parts and also assemblies name on the table, how I can remove the assembly items from the BOM table?

[MartinHanak · Accepted solution]

Hi,

you can apply filter on your repeat region. Something like

&asm.mbr.type == PART

[MohaSharifi]

Hi Martin

it works!

Thank you all

[Deepakjohsh]

HI Martin,

In continuation, is it possible to show a specific component of a sub-assembly in the BOM table of the main assembly by using Relations/ rules in Filter.

For Example:

In the below Assembly structure, Main Assembly is made of Sub-Assy1 and Sub-Assy2

If any of these Sub-Assemblies contain a pipe, I need that to be shown in the BOM table of MAIN Assembly

Is it possible to do this with help of relations/Rules in the repeat region?

 Assembly_tree

MAIN ASSEMBLY BOM TABLE:

Bom_Table

Thank you!

Deepak

[MartinHanak]

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@Deepakjohsh wrote:

HI Martin,

In continuation, is it possible to show a specific component of a sub-assembly in the BOM table of the main assembly by using Relations/ rules in Filter.

For Example:

In the below Assembly structure, Main Assembly is made of Sub-Assy1 and Sub-Assy2

If any of these Sub-Assemblies contain a pipe, I need that to be shown in the BOM table of MAIN Assembly

Is it possible to do this with help of relations/Rules in the repeat region?

 Assembly_tree

MAIN ASSEMBLY BOM TABLE:

Bom_Table

Thank you!

Deepak

---

Hi,

you can define 2 repeat regions, first one for top level components and second one for pipes.

[Deepakjohsh]

Hi,

Thanks for your reply.

I continued working on this issue and was able to find a solution as well.

I thought I'll post it as well so that it could be of use to somebody later.

Assembly structure of Main assy is as follows:

The Pipe.prt is modeled with flexibility and I introduced a parameter called "ShowinBom" and set it as a boolean value. I leave this parameter set to the default value "NO" and I set this value to "Yes" only when its a part of a sub-assy.

in the Drawing, I use two repeat regions

Result is:

Thanks,

Deepak

[benman2468]

Hi Deepak,

Just wanted to let you know that you're a lifesaver. You're method worked like a charm.

For anyone reading this in the future who is not sure how to use flexible modelling like me, you can access the "parameters" window through Model -> Model Intent -> Parameters. You can't set an original value, but you can make a new parameter called SHOWINBOM and set it to yes. The rest of the steps are perfect.