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I need drawing proprogram

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JAK
Regular Member
Regular Member

I need drawing proprogram

I tired but not working.I need to know about how do drawing proprogram,So tell me what is the procedure.

1 ACCEPTED SOLUTION

Accepted Solutions

Re: I need drawing proprogram

Hello @BenLoosli

 Thank you for information,  I have edited

Parthiban Kannan

href="https://www.linkedin.com/in/parthiban-kannan/" target="_blank"

View solution in original post

10 REPLIES 10

Re: I need drawing proprogram

Here are some tips (sadly I'm on WildFire 4)

First you will have to create a "Drawing State"

"Tools" --> "Drawing Program..." --> "Define States" --> "Create State" --> Enter a name for the state, for example "TEST"

Then, you can record the commands that the drawing state must perform, like show/erase dimensions of views.

Last, you will have to write a bit of PRO/PROGRAM to tell when that state must be activated.

"Tools" --> "Drawing Program..." --> Edit Program --> "File Edit"

IF YES

SET STATE TEST

ENDIF

Close the editor, save changes, hit "Done" or  "Done/Return".

Ofcourse you will have to edit the first line (IF YES) to suit your needs. You can use parameters from the model (part/assembly).

Example:

IF HIDE_3D_VIEW == YES

  SET STATE HIDE_3D

ENDIF

Re: I need drawing proprogram

Hello Arun,

For your request, I have created this article

Creo Drawing Program to utilize the Same Engineernig Drawing for both US and Europe Manufacturers / ...

Parthiban Kannan

href="https://www.linkedin.com/in/parthiban-kannan/" target="_blank"

Re: I need drawing proprogram

That document not in link,Shall you send Again that document,how to do drawing proprogram

Re: I need drawing proprogram

Hello @JAK

Sorry for the inconvineance, My database was corrupted some days ago. I working on that, it may take some times to reactivate that link

Parthiban Kannan

href="https://www.linkedin.com/in/parthiban-kannan/" target="_blank"
JAK
Regular Member
Regular Member
(in response to JAK)

Re: I need drawing proprogram

Thank you Teun Ham‌ & Parthiban Kannan‌.It was very helpfull to me.

Re: I need drawing proprogram

[sgrb_review id=4]

Can you use the same engineering drawing for the US and Europe Manufacturers?

Most of the US Manufacturers follows the Third angle projection and Most of the Europe Manufacturers follows the First angle projection.

Here we have to send the same casting drawing to the both supplier with their requirement.

Creating multiple drawings for the same model is a bad Idea. During changes in the model causes update required for all the drawings

So create same drawing to use both First angle and the Third angle projection

I am going to control the drawing based on the model parameter named SUPPLIER and based on the SUPPLIER value the drawing will update the view state.

If the Supplier value in parameter is "USA" then the drawing view state in Third Angle Projection otherwise it should be in First angle projection



CREATE MODEL AND ADD PARAMETER

Front and Back View of the Casting Model



Create the 3D Solid Model. Here I have created the casting model shown in the figure







Go to the Tool → Parameter







Create a New parameter named SUPPLIER and Set the Value EUROPE





CREATE DRAWING AND PLACE VIEWS




Now Create the Drawing for the model and place the General View and the Default Projection Views of the model (My Default Projection in Third Angle)





CREATE VIEW STATES 




Go to the Tools → Drawing Program



Select Define States


Create States named FIRST_ANGLE and THIRD_ANGLE





RECORD COMMANDS FOR THIRD ANGLE VIEW STATE

Now record the commands for THIRD_ANGLE



Go to Drawing Program → Define States → Edit State → THIRD_ANGLE → Record Cmds







Select Views and move the General and projection views as per Third Angle Projection



The adjusted Projection View for the Third angle




Click Done to complete the Record Command for THIRD_ANGLE State




RECORD COMMANDS FOR FIRST ANGLE VIEW STATE

Now repeat the same steps to Create FIRST_ANGLE State



Go to Drawing Program → Define States → Edit State → FIRST_ANGLE → Record Cmds







Select Views and move the General and projection views as per First Angle Projection



The adjusted Projection View for First angle





Click Done to complete the Record Command for FIRST_ANGLE State




APPLY THE CONDITION / LINK WITH MODEL PARAMETER

Let us control the states via the Parameter using If condition in the Drawing Program



Go to the Drawing Program → Edit Program → File Edit


Just write down this code with your notepad editor.



IFSUPPLIER == "USA"

 SET STATETHIRD_ANGLE

ELSE

 SET STATEFIRST_ANGLE

ENDIF



Here

SUPPLIER is the Parameter we created with the model

USA is the value for the Parameter SUPPLIER

FIRST_ANGLE and THIRD_ANGLE is the States we have created with Drawing Program

That's all

Now just change the Model Parameter SUPPLIER Value to USA which results the drawing automatically change it state to First Angle and for other parameter value results in Third Angle state.

Thank you

Parthiban Kannan

href="https://www.linkedin.com/in/parthiban-kannan/" target="_blank"
Tags (1)

Re: I need drawing proprogram

This is wrong! Most US drawings are Third angle and european drawing are First angle.

Re: I need drawing proprogram

Hello @BenLoosli

 Thank you for information,  I have edited

Parthiban Kannan

href="https://www.linkedin.com/in/parthiban-kannan/" target="_blank"

View solution in original post

Re: How to control part in drawing proprogram

I want to control part in asm drawing.

For example A,B,C are parts in D.asm..

Now D.drw,I no need of A.prt details and i wont show related A.How to do in drawing program.

Re: How to control part in drawing proprogram

In which condition you show the A.prt details on the D.drw?
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