extract material properties

[sr-4]

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[MartinHanak]

Hi,

you can:

• create auxiliary drawing containing with your assembly set as drawing model
• create table with repeat region in the drawing
• 1st column ... &asm.mbr.name
• 2nd column ... &asm.mbr.ptc_material.PTC_MATERIAL_NAME
• select the table and save it as csv file
• change csv file name extension to txt
• open txt file in Excel and save it as xls file

MH

[sr-4]

Hi Martin

Thank you so much for your Reply.

I am really looking to generate an text file or CSV file from  Creo  without going into the drawing information.

Say  I have 20 parts in my active window under one assembly with the tree window on left side.

I am looking a script or procedure to generate a txt or csv file t have part number in forst colum and material properties in the second coulmn.

The reason I am asking this question is used use for my simulation using external solvers.

Thank you

[MartinHanak]

Hi,

you can also configure Model Tree to show PTC_MATERIAL_NAME parameter in its column and use Save Model Tree command.

MH

[psobejko]

Also, you can set it up so that the BOM shows the material information of the components:

create a text file somewhere on your hard-disk called, for example, my_bom_format.txt with these contents:

.summary
==========================================================================================================================
Summary for %$type %$name
==========================================================================================================================
.titles Name; Material
--------------------------------------------------------------------------------------------------------------------------
.row %$name[-40s]; , %PTC_MATERIAL_NAME[-30s]

(the $name is a special identifier that lists the name of the component, the % delimits a column, [-40s] is a format specifier)

other options available, search these forums and the internet for good tips.

reconfigure the config.pro option to point to this file:

bom_format C:\my_path\my_bom_format.txt

Then use the assembly tool "Bill of Materials" to generate the table.  A text file named after your assembly with .bom.x extension will be generated in your working directory everytime you use the tool (x will be the incremented).

[sr-4 · Accepted solution]

Hi psobejko

Thank you so much . It is working Perfectly 100%

Thanks a lot

Srini