part number in multiple sheet drawing

[thlavinka]

Hello,

I use multiple sheet drawings and would like to automate part numbers on all sheets according to a relation in parts and subassemblies (the part number must be same on each sheet).

I made this relation: part_number="415-"+rel_model_name:1+"-12"

Is there some way to fix the underscored number to remain always 1?

Thanx in advance

Tom

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[SYNDAKIT]

1 is the session id of whatever assembly you are using. could you explain more about what you want in the end exactly?

[thlavinka]

In each subassembly and part drawing sheet i want to have the same as on the first sheet (what is a top assembly) it means 415-"+rel_model_name:1+"-12 where the rel_model_name is the model name of top assembly.

[mender]

What is it that you want to be same?  Is it 'the text in a note in a particular table cell in the title block part of my format'?  (That's my best guess right now.)  Or something else?

[thlavinka]

yes, right that..

[mender]

Sounds good.  So I'd say your title block in your template drawing or format contains "415-{0:&DWG_TOP_MODEL_NAME}-12" (or depending on your intent for future drawings, "&DWG_TOP_MODEL_SHOWN" with a relation constructing param dwg_top_model_shown from dwg_top_model_name.

For bonus points, you can drive this parameter in the drawing from a parameter in the solid.  From Creo 2 M150 or Creo 3 M040, you can put the syntax 'DWG_TOP_MODEL_NAME:D = REL_MODEL_NAME:MDL' in your Drawing Program in your template drawing, not needing to have a solid model yet, and it will link to the first solid model you put in the drawing.  In these builds and later (this is when ':MDL' is introduced), you can also put this directly in the table in the template, as "415-{0:&REL_MODEL_NAME:MDL}-12".

[thlavinka]

Thanks Matthew

My creo version is Creo 2.M120.

Since i am not good at relations can you please describe exactly what destinaation to put each relation in?

- "415-{0:&DWG_TOP_MODEL_NAME}-12"  to the drawing format - that is clear

theese two relations i am not sure

- "&DWG_TOP_MODEL_SHOWN"

- dwg_top_model_shown from dwg_top_model_name

Thanks a lot

[mender]

Exact syntax is difficult when it isn't clear what exactly you're looking for, like whether the '415-' and the '-12' will vary between different sets of drawings.  If you don't want to deal with relations, you should probably do the '90% value with 10% effort' approach and just have the note have a callout of the drawing parameter, and fill in the parameter manually once for each (however-many-sheets) drawing.

[thlavinka]

the '415-' and the '-12' will never vary.

here is an example: the top assembly model name is 473-1111 and desired drawing number should be 415-473-1111-12

[StephenW]

If your drawing file name is 415-473-1111-12.drw, you can use &dwg_name to get that output.

[StephenW · Accepted solution]

One other thought somewhat off the original question. You might consider using the drawing name instead of the model name. Just a thought, it really depends on exactly what you are trying to accomplish.

[thlavinka]

How simple, thank you Stephen

It is enough to use the syntax like 415-&dwg_name-12 in dwg format

[kdirth]

I sometimes run into the same issue.  I have found that you need to ensure the active model in the sheet is the correct model needed for the title block when the format is added/updated.

[thlavinka]

I just need to ensure that all sheets have the same title name and number as the first sheet (top assembly) no matter whether it is a subasm drawing, part drawing, scheme,...

[BenLoosli]

Put a relation in your drawing file then use your new drawing name for the drawing sheets.

Sheet_Number = '415-'+&dwg_name+'-12'

Then use Sheet_Number on all drawing sheets for the part number and all sheets will be the same.