CREO 2.0 M090 drawing regenerate problem

[ptc-2803746]

Hello !

I am facing an issue on Creo 2.0 M090. When I open a drawing and its model, and change the model it's not been updated on its drawing, even after I use the REGEN command. I've tried it with and without my present config.pro configurations with the same result.

As an example, I'm sending a model and a drawing. The drawing doesn't reflects the model anymore. Opening the drawing and hitting the regen command it doesn't update the drawing. The only way I found to walk around the problem is to force a second unnecessary change, regen in the model + drawing, and them undo the unnecessary change.

Is there anyone facing the same issue ? Does anyone knows how to solve it ?

Thanks !

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[MartinHanak]

Hello,

I modified your model and switched to a drawing. The change was propagated into the drawing.

My suggestion .... rename your config.pro to config.proxxx temporarily and do a test with uploaded files.

Martin Hanak

[ptc-2803746]

Hi Martin !

Thanks for your answer and trial.

Yes, I've tried to do exactly it as well, deactivating the config.pro. The result was the same.

Have you tried to just open the drawing and tried to regen it ? Observe that the holes in the model are more inside to the part than showed in the drawing.

Best regards

[MartinHanak · Accepted solution]

Hello,

now I understand your problem .

Enlarge message area at the bottom of Creo window before you open evt-aa-0006-1.drw.

Open evt-aa-0006-1.drw >>> Creo displays the following warning:

Retrieved object was previously saved with display

To update your drawing:

• activate Review tab
• click Update Sheets button

Edit your config.pro and set:

save_display no

Martin Hanak

[ptc-2803746]

Wow. That's it !

Thanks a lot, Martin !!!

Wish you a great weekend