Annoying Model Tree in Creo Parametric 7

[JM_10474452]

When reordering Model Tree, It is too easy to accidentally move part to subassembly (Can take long time to undo).

Creo should ask confirmation when user clicks Expand All, because it takes so long with large assemblies.

Actually I have never needed to use expand all, but i sometimes accidentally click it when i try to click Collapse All.

Btw. why Measure -tool is so slow unless you use selection filter?

[BR84]

hi

Expand all - don't use it - it does exactly what it says - it expands all

• use shortcut keys - shift + E - expand (default)
• collapse - shift + C (my custom set shortcut key)
• select more than one feature/part/ assembly - and hit shift + E

measure tool

• record a mapkey
  • measurements + setting a requested mode
• I use mm - measurement
  • vmm - vertex
  • emm - edge

reordering

creo is for engineers - you need laser focus. In newer versions, it seems it has been upgraded, or I have done it so many times and dealt with the consequences you have mentioned, that I don't do it any more. 

[JM_10474452]

Thanks for the good tips.

I guess i have to recharge my laser.

Model Tree is manageable but annoying compared to many competitors.

Nice to know that there are improvements comming.

[StephenW]

Per this "idea" https://community.ptc.com/t5/Creo-Parametric-Ideas/Stop-Model-Tree-Reorder-Becoming-a-Restructure/idi-p/467294

there is a config.pro option to dis-allow the restructure in the model tree.

and also more fixes later: Status changed to: Implementation In Progress    being worked on for Creo 10.0

Please check out Creo 4.0 M040 for "enable_dragdrop_on_components".

We've now added a new config option to prevent restructuring in the Model Tree. It's called "enable_dragdrop_on_components" and allows to choose between "all"(default) and "reorder".

• "All" allows both operations, Restructure and Reorder.
• "Reorder" allows you to only reorder components and features via drag&drop in the Model Tree; Restructure is then prohibited.

Restructuring via the ribbon/menu commands is still then possible.

[JM_10474452]

Nice to know that there is "enable_dragdrop_on_components" -hidden configuration option. Is it possible to use Keyboard Shortcut to change the value of that option or can it only be changed with Configuration Editor?

[StephenW]

I'm not sure why it is now a hidden option. It used to not be a hidden option.

You can't directly change a config.pro option with a mapkey. You can however set up a mapkey to load a config.pro that contains only one option. You would make the mapkey that would load the config.pro from a folder on your computer. You would make another mapkey that would load a different config.pro to turn off the option.

[JM_10474452]

Maybe the real solution to this problem is coming in new version.

[StephenW]

I would never wait on PTC to solve problems that I can come up with work-arounds for...this is strictly my opinion. PTC prioritizes software releases to new features mostly and only throws in a handful of fixes or feature improvements. Usability is very low on the priority list.

[tbraxton]

It is possible to make a toggle like mapkey, not a true toggle because an assumption must be made about the initial state of the logic. 

See this thread for examples and some guidance on how to do it,

https://community.ptc.com/t5/3D-Part-Assembly-Design/Mapkey-Toggle-Grid-HIDE-Grid-SHOW-Grid/m-p/792688 

[MartinHanak · Accepted solution]

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@JM_10474452 wrote:

Nice to know that there is "enable_dragdrop_on_components" -hidden configuration option. Is it possible to use Keyboard Shortcut to change the value of that option or can it only be changed with Configuration Editor?

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Hi,

you can create two config files:

config_dragdrop_yes.pro containing single option ... enable_dragdrop_on_components  yes

config_dragdrop_no.pro containing single option ... enable_dragdrop_on_components  no

Then you can create two mapkeys:

• first one loads config_dragdrop_yes.pro
• second one loads config_dragdrop_no.pro