Removing General Linear Tolerances Without Affecting Local Feature Tolerances

[EnriqueNunez]

Hi everyone,

I’m working with the team in charge to move to MBE, and I’ve run into a challenge I hope someone can help with.

I’m trying to remove the general linear tolerances that appear on every part (see attachment 1). I experimented with setting the "tol_Display" option to "no", which does remove the general tolerances, but unfortunately, it also hides all the local tolerances on features of size (see attachment 2 and 3).

Has anyone found a way to remove just the general linear tolerances while keeping the local ones visible?
I’ve attached a reference image to show what I’m working with. Any tips, workarounds, or settings I might have missed would be greatly appreciated!

Thanks in advance!

[KenFarley]

The tol_display config option has three possible settings: no, yes, and no_tol_tables. You might want to try the last one.

[EnriqueNunez]

I did, but the result it's the same, both tolerances, local and general, are gone.

[Van_AG]

Set config option tolerance_standard to iso

For existing models and model templates set

File > Prepare > Model Properties > Tolerancing Standard > Standard > ISO/DIN

[EnriqueNunez]

Hello,
I tried the option you mentioned, and it successfully achieves the intended result (see attachment). However, since we are currently working on the project to transition our company to a Model-Based Enterprise (MBE), we primarily use models based on the ASME standard, though we also incorporate models aligned with ISO GPS. As part of this initiative, it is a requirement to manage the dimensioning and tolerancing system also represented within the 3D model. Therefore, this solution would conflict with that requirement.

[Catalina]

Hi @EnriqueNunez ,

I wanted to see if you got the help you needed.

If so, please mark the appropriate reply as the Accepted Solution or please feel free to detail in a reply what has helped you and mark it as the Accepted Solution. It will help other members who may have the same question.

Of course, if you have more to share on your issue, please pursue the conversation.

Thanks,

[EnriqueNunez]

Hi, thank you for following up. I haven’t received a clear answer to my question yet. 

[pausob]

So... you want the model to use the ASME standard but don't want to see that tolerance per decimal-places table in that graphics area?

That's not possible, AFAIK, except perhaps with this hack:

Set the "Secondary Highlight" color to be the same as "Background" color:

[JakubBanasiuk]

File > Prepare > [Detailing Section] Detail Options - CHANGE:
default_tolerance_mode: nominal

This will set the default tolerance to nominal, so when you place the dimensions, they will have no tolerance by default:

Only after you've changed it to, say plus-minus, the tolerance will appear. You can then select your tolerance table or set manual tolerance values:

Hope this is what you are looking for. If so, you can apply this setting in your speciffic template file - you can then select if for specific purpose only.