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M
mwaghmode1-Visitor
1-Visitor
June 17, 2015
Question

What is the PTC parameter for Quantity.

  • June 17, 2015
  • 5 replies
  • 7328 views

Hello Creo Experts,

What is the PTC parameter for Quantity.

I want to create user define parameter which contain actual part quantity+spare quantity.

which need to replicated in BOM table as (4+8)

where 4=actual part quantity used in assemble

and 8=spare quantity delivered with product.

spare quantity will be user input.

Thanks you in advance

Best Regards,

Manoj


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5 replies

R
RonSt.Pierre12-Amethyst
12-Amethyst
June 17, 2015

that would be  &rpt.qty in the BOM table repeat region

M
mwaghmode1-VisitorAuthor
1-Visitor
June 17, 2015

Thanks Ron St.Pierre,

How can assign the Value of quantity as actual quantity + spare.

so that my BOM quantity looks like 8+4.

somthing I will create Relation QTY= &rpt.qty+spare.

R
RonSt.Pierre12-Amethyst
12-Amethyst
June 17, 2015

Assuming you have a bom table, in the table tab > repeat region, select relations then your repeat region in the bom table.

A menu will come up where you can write some programming.

Put this in your relations:

bom_qty=rpt_qty+4

Then in your bom table, the first row of your repeat region, select it (if you select switch dims in the table relation menu, you will see the parameters)

we need to change what is being reported in the bom table

Right mouse button > report parametets

select rpt... > rel... > User Defined > type in bom_qty

switch your symbols back then update tables.

ron


    D
    DonSenchuk12-Amethyst
    12-Amethyst
    June 17, 2015

    For the components that are supposed to show additional items in the BOM table, use the Include function in the assembly rather than manipulating the BOM table.

      M
      mwaghmode1-VisitorAuthor
      1-Visitor
      June 17, 2015

      Thanks Don,

      will it replicate in BOM?

      My customer want it in BOM table only.

      Regards,

      manoj

      D
      DonSenchuk12-Amethyst
      12-Amethyst
      June 17, 2015

      Yes, it will show up in the BOM. It will show in the Model Tree, but it will not be shown in the CAD model. I'm pretty sure the intent of the Include function is specifically for cases like yours. It's pretty easy to use, so, try it out.

      M
      mwaghmode1-VisitorAuthor
      1-Visitor
      June 17, 2015

      Thank you all.

      Appreciate  your quick help.

      Dale_Rosema
      23-Emerald III
      Dale_Rosema23-Emerald III
      23-Emerald III
      June 18, 2015

      Coming late to the discussion, but this was a similar thread where I only needed 1/2 of a part:

       

      1/2 of a part

       

       

      Patriot_1776
      Patriot_177622-Sapphire II
      22-Sapphire II
      June 17, 2015

      Interesting stuff here.  While I don't have a use for it as yet, I'll have to check it out, thanks!

      J
      James621-Visitor
      1-Visitor
      June 19, 2015

      Not tested, but I guess the following code will do the trick. Put it in repeat region relations.

      IF exists("asm_mbr_spare_check")

          RR_SPAREQTY_CHECK=asm_mbr_spare_check

      ELSE

          RR_SPAREQTY_CHECK=false

      ENDIF

      COPY_OF_SPAREQTY=asm_mbr_spare

      IF COPY_OF_SPAREQTY<>"" & COPY_OF_SPAREQTY<>" " & RR_SPAREQTY_CHECK=true

          USER_QTY=rpt_qty+"+"+asm_mbr_spare

      ELSE

          USER_QTY=rpt_qty

      ENDIF

      For the code to work &rpt.rel.USER_QTY needs to be defined in the repeat region column table, SPARE parameter needs to be defined on part level as a string, SPARE_CHECK parameter also at part level as boolean, and I think that's it.

      If you don't like the SPARE_CHECK thing you can just weed it out, but I can't tell for sure the code is gonna work without it. Just have to test it.

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