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DebraTossey1-Visitor
1-Visitor
November 11, 2015
Solved

Grouping in the model tree

  • November 11, 2015
  • 2 replies
  • 7334 views

Grouping in the model tree.

I inherited a small assembly (about 100 items) from an employee who is no longer here, and ran into something that I, and a few others, have not seen before before.

When working in the assembly I grouped several fasteners together just to reduce my model tree, so I could correct some other issues.

After I got everything cleaned up (leaving the group in place) I started cleaning up the drawing and I noticed some rivets were missing in the views, not on the parts list.

I went back to the assembly and searched for the rivets and found that I had them grouped. When I highlighted on the group I could see the outline of the rivet, but it was invisible. These items were not hidden or suppressed, they were just grouped and invisible.

When I ungrouped, the rivets reappeared!

I grouped them back together and they were invisible again. The drawing parts list showed no change like suppressing an item. I was in "MASTER REP" when I did all of this grouping and un grouping.

I am on CREO 2.0 build M160. I then tried the same assembly on CREO 2.0 build M110 and got the same results.

I then opened an entirely different assembly, (one I worked on about a month ago), using (CREO 2.0 build M110) and I grouped some items in the assembly, and the items did not disappear.

No one here has seen this issue.

Has anyone seen this happen before?

Thanks in advance.


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Best answer by MartinHanak

You can unhide all layers temporarily to verify this idea.

MH

2 replies

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dgschaefer21-Topaz II
21-Topaz II
November 11, 2015

Is there a hidden rule based layer that looks for groups?

M
MartinHanak24-Ruby IIIAnswer
24-Ruby III
November 12, 2015

You can unhide all layers temporarily to verify this idea.

MH

J
jmandravelis1-Visitor
1-Visitor
September 12, 2016

I agree with the answer you can unhide all layers, but that isn't helpful when you are trying hide other items on layers such as datum planes, axes, etc.

For an alternative solution I found a specific rule written in the default layer rules that when removed fixes this problem.  Select the layer that has the grouped components and click properties.  Then select the rules tab and click Edit Rules.  There is a rule in there "Type != Has Geometry (Category Miscellaneous)"  Select this layer (or a similar layer that value is "Has Geometry") and click Remove and click Ok.  Now then next time you go to group components in the assembly it will not put the group on the layer.  See the image below.


Layer Editor.PNG

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