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C
cjohansson-21-Visitor
1-Visitor
April 10, 2014
Question

How do I add this dimension

  • April 10, 2014
  • 3 replies
  • 11512 views

Hi

I am trying to dimension a drawing.

I want to dimension the upper bend as I did on the lower bend (20,3), see picture.

I want the dimension to be from the end of the bend to the outer tangent of the bend radius (outer).

The dimension shall be slanted along the direction of the bend.

In SolidWorks you just selected the end line of the bend and the radius.

Right click-select max dimension.

I don´t know how to make this in creo.


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3 replies

J
jsarkar1-Visitor
1-Visitor
April 10, 2014

you may need to create draft entities..I guess

C
cjohansson-21-VisitorAuthor
1-Visitor
April 10, 2014

I´m not sure about what you mean?

KenFarley
KenFarley21-Topaz II
21-Topaz II
April 10, 2014

Is that dimension to the intersect points? If so, then

(1) Change the "attach type" to "Intersect"

(2) Pick the points by picking the first entity then holding the CTRL button while picking the second

(3) Hit the middle mouse button to place the dimension. It will ask you what the orientation should be. Pick "Parallel", then select the line you want the dimension to be aligned with.

Hopefully I'm not oversimplifying your needs.

C
cjohansson-21-VisitorAuthor
1-Visitor
April 10, 2014

No it´s not the intersect points.

I want the dimension to be to the maximum distance of the arc (tangent) parallell to the bend.

J
jsarkar1-Visitor
1-Visitor
April 10, 2014

go to sketch tab and create draft create some extended intersection points, then you may dimension it?

L
lroose1-Visitor
1-Visitor
November 24, 2014

To avoid ambiguity, use detail views and increase scale to clearly show the dimension is to the tangency and not to the intersection point.

In Creo 2.0, you have at least two options to get what you want. I used a simple extrusion to illustrate. I don't know how you created your geometry and I haven't used the Sheet Metal package to know if this works there.

1. In your model sketch, pick the end of the bend leg and the bend arc and right click to locate the dimension. It doesn't seem to make a difference where you pick on the arc. The dimension will be to the arc tangent. (See the 80.000 dimension in the picture.)

tangent+dimension+sketch.png

Then, on your drawing, use Show Model Annotations to display the dimension.

2. If you modeled differntly and need to create the dimension on the drawing, select On Entity for dimension attachment type and pick the end of the bend leg and the bend arc.

tangent+dimension+picks.png

Then, middle click to accept and select Tangent for arc pnt type.

dim+arc+pnt+type.png

The dimension is placed.

tangent+dimension.png

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