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HarikrishnanR1-Visitor
1-Visitor
February 10, 2015
Solved

Logo on Creo part and drawing interface

  • February 10, 2015
  • 5 replies
  • 25186 views

Dear Experts,

I just need to create a parametric company logo on Creo part interface and the logo symbol should have only one controlling dimension even though it has extricating geometry.

Scope:-

· 1. To Create a scalable Logos on Creo and need to emboss logo on part model and add material.

· 2. Logo will be controlled by a single dimension.( Example: Logo size should be controlled by height, if H equals height and the width is 5 times longer than the height then the width would be 5*H.)

· 3. Create dimensions that are all a function of the vertical length of the left most line.

Can we create on text form and use as library file. (Example: with “.ndx” is the file extension)

Could you please guide me on this?

Thanks in advance!

Hari


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Best answer by TomD.inPDX

Tom is on the right track using a relation for each dimension based on the height you want.

Your best option is to find the right font and just make a palette sketch from that.

As Tom said, you might have trouble maintaining relations for a palette sketch if using curves. These normally have to stand on their own. However, if you have a fully dimensioned sketch; easy way to place the sketch (lower left; center-center... etc) independent of references in the master, you can scale the sketch when you drag it into your section and all the dimensions will scale with it and remain fully associative. I suggest using strong dimensions in your section file. If the master is "1" unit, then you can scale it on insertion to your needs... the downside is that you cannot change the scale at will. You will have to reinsert the palette section.

Other methods just get to exotic to manage easily.

It certainly wouldn't be the 1st time I put the image in as a background to overlay the geometry for the "master" file. Just find the best, crispest, largest approved logo you can find and add the image as a BMP file to a datum plane; scale and align it to something reasonable, and develop a sketch over the top of it.

5 replies

T
23-Emerald IV
TomU23-Emerald IV
23-Emerald IV
February 10, 2015

I did something similar at a previous company. Basically I imported the logo as a graphic and then created a bunch of points (in one point feature) on top of it and then connected them with lines and arcs to create the logo outline. I then added relations statements for each the point's dimensions and tied them back to a scale factor based on a single dimension. The whole thing was saved off as a UDF and could be easily reused to create logos in extrudes, curves, cosmetic sketches, etc. As simple as your logo is this should be really easy to recreate.

The other thing you could do is create a sketch and then add sketch relations, but I'm not sure if sketches saved to the palette can include relations in them.

    T
    TomD.inPDX17-PeridotAnswer
    17-Peridot
    February 10, 2015

    Tom is on the right track using a relation for each dimension based on the height you want.

    Your best option is to find the right font and just make a palette sketch from that.

    As Tom said, you might have trouble maintaining relations for a palette sketch if using curves. These normally have to stand on their own. However, if you have a fully dimensioned sketch; easy way to place the sketch (lower left; center-center... etc) independent of references in the master, you can scale the sketch when you drag it into your section and all the dimensions will scale with it and remain fully associative. I suggest using strong dimensions in your section file. If the master is "1" unit, then you can scale it on insertion to your needs... the downside is that you cannot change the scale at will. You will have to reinsert the palette section.

    Other methods just get to exotic to manage easily.

    It certainly wouldn't be the 1st time I put the image in as a background to overlay the geometry for the "master" file. Just find the best, crispest, largest approved logo you can find and add the image as a BMP file to a datum plane; scale and align it to something reasonable, and develop a sketch over the top of it.

      S
      sm_011-Visitor
      1-Visitor
      February 10, 2015

      Definitely not my area of expertise any more, but PTC Technical Support offers the following Knowledge Base Article on this topic: "How to Create a Logo in Creo Parametric".

      For me, the general rule of thumb is to get the logo in vector format, convert it to a CAD compatible format and if no dimension control is required, import it as a curve from file. Once created, you can scale the model to adjust the size and then create new curves via export or reuse as a UDF.

        M
        MartinHanak24-Ruby III
        24-Ruby III
        February 10, 2015

        Hello,

        if you are working for HCL company, then ask somebody in marketing department to provide you TrueType font containing specific H,C,L characters. Then put the font into Creo2\Creo 2.0\Common Files\Mxxx\text\fonts directory. Start Creo a create Extrude feature using text written by added font.

        Martin Hanak

          T
          TomD.inPDX17-Peridot
          17-Peridot
          February 10, 2015

          Many fonts are licensed. Copying them may be a violation. Be sure the company has a site license first for that font if it is not a readily available open source font.

            H
            HarikrishnanR1-VisitorAuthor
            1-Visitor
            February 12, 2015

            Dear Sir,

            My customer requirement is to create the Logo as font format and it can be use in sketch mode to add or remove material from the CAD model.

            I need to use below mentioned sketch interface to call the Logo ( as font, that save in Library) .

            Example:-

            Convert,

            Logo JPG --> as "New Font" creation and call in Creo modeling phase( sketch mode)

            Logo JPG --> Symbol ( that can be protrude in modeling phase) (sketch mode)

            Thanks,

            Hari

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              V
              VladimirPalffy14-Alexandrite
              14-Alexandrite
              February 11, 2015

              Hi folks - every body is right (create logo by points, use custom font, relations, etc.). I use all this technics for my model of PTC logo.

              Base question is: how to scale created logo?

              My answer:

              • Create 2D sketch or 3D model of logo (custom predefined dimension)
              • If you need reuse the sketch with different scale - it is not problem. Save the section to your library and then you can easy scale sketch in Sketch mode

              scale_sketch-creo.jpg

              • If you need to scale 3D model >> make a copy of original model >> OPEN model >> and use function SCALE MODEL (set custom scale factor and ... )

              scale_model-creo.jpg

              Have a nice day,

              Vladimir

              H
              HarikrishnanR1-VisitorAuthor
              1-Visitor
              February 11, 2015

              Dear All,

              Thank you very much for your valuable guidance.

              Actually need to create Logo as library component and need to store as either text symbol or Font (.ndx) (Then put the font into Creo2\Creo 2.0\Common Files\Mxxx\text\fonts directory )

              so that I people can call the Logo whenever they needed from the library.

              Thank you very much for your time!

              Regards,

              Hari

              Example-+Logo.JPG

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              “Share your knowledge. It is a way to achieve immortality.” - Dalai Lama.

                M
                MartinHanak24-Ruby III
                24-Ruby III
                February 11, 2015

                Hello,

                just one note ... You cannot use Creo font to represent logo. This is because Creo font contains characters defined as sequences of straight lines. You cannot define arc, circle or spline.

                Example of Creo font:

                font name ... font

                font index file ... font.ndx

                font files (source) ... ascii.src, special.src, latin_1.src

                font files (compiled) ... ascii.fnt, special.fnt, latin_1.fnt

                Martin Hanak

                  H
                  HarikrishnanR1-VisitorAuthor
                  1-Visitor
                  February 11, 2015

                  Dear Martin,

                  Can we use multiple straight line to contruct curve and save as font.ndx?

                  how can be create a font.ndx file?

                  Thanks

                  Hari

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