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M
meline1-Visitor
1-Visitor
October 25, 2016
Solved

Detailing model sketches on a drawing

  • October 25, 2016
  • 6 replies
  • 2676 views

I have a model in which several boundary blends create the part geometry. A series of sketches are consumed within these boundary blends. I want to detail those sketches on a drawing, but how can i remove the physical geometry to only show/detail the sketches?


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Best answer by KenFarley

I would probably make a family table. I'd select the sketch features as members of the family table, and any other features I want or don't want on the drawing. It might be a lot of features. Then, I'd set up an instance that just has the sketch of interest and turns off all the other things I don't want. Once you're doing the drawing, you "Add a Model" to bring in the instance with the sketch, and then make a view for the sketch. After that it's the usual tedious dimension addition. You switch back to the main model of the drawing by using the "Set Model" function in drawing.

6 replies

kdirth
kdirth21-Topaz I
21-Topaz I
October 25, 2016

To remove the physical geometry use edge display in the Edit tool box.  Select Edge Display, select Erase Line in the dialog box, window select all of the geometry, and select OK and Done.  This should leave you with only sketches and curves.

There is always more to learn.
M
meline1-VisitorAuthor
1-Visitor
October 25, 2016

Thanks, Kevin, but the family table approach, though a bit tedious, is giving me better results. In trying to navigate the edge display not all of the geometry would remove, and some of the sketches I wanted beneath would not display. Though, perhaps, there are a few tweaks which I was not properly doing.

KenFarley
KenFarley21-Topaz IIAnswer
21-Topaz II
October 25, 2016

I would probably make a family table. I'd select the sketch features as members of the family table, and any other features I want or don't want on the drawing. It might be a lot of features. Then, I'd set up an instance that just has the sketch of interest and turns off all the other things I don't want. Once you're doing the drawing, you "Add a Model" to bring in the instance with the sketch, and then make a view for the sketch. After that it's the usual tedious dimension addition. You switch back to the main model of the drawing by using the "Set Model" function in drawing.

J
John.Pryal1-Visitor
1-Visitor
October 26, 2016

Wouldn't a simplified representation have been easier? Just a thought.

John

kdirth
kdirth21-Topaz I
21-Topaz I
October 26, 2016

I agree that a Simplified Rep may be the better choice.  Family tables can be problematic especially if using windchill.  We only use family tables for hardware and only one person is allowed to make changes.  Our administrator has told us repeatedly to not create family tables.

There is always more to learn.
Patriot_1776
Patriot_177622-Sapphire II
22-Sapphire II
October 26, 2016

Layers.  You can change layer status per view.  Make a layer for "solid geometry" (use a rules-based layer), turn that layer off in the view, and you're done.

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