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PF_97905183-Newcomer
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November 13, 2023
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Dimension Text Modifications

  • November 13, 2023
  • 2 replies
  • 7153 views

 Dim Text Mods.JPGI am modifying dimension text in Creo 8. Is there a comprehensive list of text modifiers, such as @O for override or  @[{&D203} to display dimension 203 as basic when being referenced inside another dimensions dimension text?

 

 

 

 

 

 

Best answer by kdirth

Here are a few of the most popular text mods:

  • Overwrite Dimension: @O 
  • Box around text: @[***@] 
  • Superscript: @+***@# 
  • Subscript: @-***@# 
  • Super/Subscript {0:***}{1:@+***@#)@-***@# 
  • Multiple formats: 
    • To edit the style of one section of a note, first click to select the entire note, then click again to select just the section you want to change. You can then RMB -> Text Style... and change size etc. as required. 
    • This works directly with separate lines within a note, but to change just one part within a line you must first separate that section by adding {1: and } around the relevant text: 
    • {1:Large Text} Small Text 
    • Separate Line 
    • Then close the note editor and proceed as above. 
  • Round Parameter Value:  add [.X] after the parameter name, X being the number of decimals. 
  • Leader Location on Note: add @O to line on note. 
  • Use & or @:  Type twice in note e.g., && or @@ 

You can also look at Creo Help.  

Text Strings (ptc.com)   - Detailed Drawings > Annotating the Drawing > Working with Text and Notes > Modifying Note Text > Text Strings

2 replies

P
19-Tanzanite
pausob19-Tanzanite
19-Tanzanite
November 14, 2023

Yes, to learn this ancient and secret language 😅 - try these links:

Tips for text (from this forum) 

System Parameters for Drawings (from PTC help) 

    B
    23-Emerald III
    BenLoosli23-Emerald III
    23-Emerald III
    November 14, 2023

    There are a lot more system parameters in your files if you are using Windchill with Creo.

    Some of the ones listed in the PTC Help are outdated from Pro/PDM and Pro/Intralink.

    kdirth
    21-Topaz I
    kdirth21-Topaz IAnswer
    21-Topaz I
    November 14, 2023

    Here are a few of the most popular text mods:

    • Overwrite Dimension: @O 
    • Box around text: @[***@] 
    • Superscript: @+***@# 
    • Subscript: @-***@# 
    • Super/Subscript {0:***}{1:@+***@#)@-***@# 
    • Multiple formats: 
      • To edit the style of one section of a note, first click to select the entire note, then click again to select just the section you want to change. You can then RMB -> Text Style... and change size etc. as required. 
      • This works directly with separate lines within a note, but to change just one part within a line you must first separate that section by adding {1: and } around the relevant text: 
      • {1:Large Text} Small Text 
      • Separate Line 
      • Then close the note editor and proceed as above. 
    • Round Parameter Value:  add [.X] after the parameter name, X being the number of decimals. 
    • Leader Location on Note: add @O to line on note. 
    • Use & or @:  Type twice in note e.g., && or @@ 

    You can also look at Creo Help.  

    Text Strings (ptc.com)   - Detailed Drawings > Annotating the Drawing > Working with Text and Notes > Modifying Note Text > Text Strings

    There is always more to learn.
      Dale_Rosema
      23-Emerald III
      Dale_Rosema23-Emerald III
      23-Emerald III
      November 15, 2023

      Quick question, Does the Round Parameter Value actually round or does is truncate?

      kdirth
      21-Topaz I
      kdirth21-Topaz I
      21-Topaz I
      November 15, 2023

      According to the information in Creo help it is rounded:

       

      When adding the note that contains the parameter, append the parameter symbol with "[.#]", where # is the number of decimal spaces to appear. For example, if a detailed view scale is 1.125, and you want to display only two decimal places, change the drawing label to &det_scale[.2] (no spaces). This displays the scale note as 1.13.

      There is always more to learn.
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