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Yogesh.T14-Alexandrite
14-Alexandrite
January 14, 2026
Solved

.DRW not updating when TABLE changed in .FRM

  • January 14, 2026
  • 5 replies
  • 83 views

The table in .drw is not updating if I change .frm save and reload. Somrthing in .drw is not updating to see latest format file. 

SEE IMAGE of .frm and .drw

Change in .frm [B TO C]

Upadte in .drw still show B

Best answer by Yogesh.T

Here is my conclusion:

ONLY FOR TABLES

Anything incoming in .dwg from .frm tables, becomes child of .dwg

It will stay even if changed in .frm table

&name in .frm table will be asked only once for .dwg (Can be updated / deleted in dwg)

5 replies

B
23-Emerald III
BenLoosli23-Emerald III
23-Emerald III
January 14, 2026

Remove the old format file from your workspace and clear it from memory.

Try creating a new drawing and see if the proper C format is utilized.

Is the drawing size hard coded "B" or 'C' or is it using the &format parameter?

 

 

    Y
    Yogesh.T14-AlexandriteAuthor
    14-Alexandrite
    January 15, 2026

    Update in .frm TABLE does not update in .drw TABLE (SAME CELL). Nothing to do with B or C format size. 

    In another words,

    Once captured table cell input from .frm by .drw NEVER CHANGES even the input in table cell of .frm is deleted/changed.

    M
    MartinHanak24-Ruby III
    24-Ruby III
    January 15, 2026

    Hi,

    you described standard Creo functionality.

    When you create new drawing using .frm, Creo copies tables from .frm to .drw. These copied tables are independent on tables defined in .frm.

    Suggestion:

    • remove current format from drawing ... apply simple frame available OOTB
    • do not forget to remove all tables when you are asked
    • set new format

     

      M
      Martin_Hill10-Marble
      10-Marble
      February 23, 2026

      You should not even try to enter the Revision value into the drawing format file unless it is done using a parameter that will be populated with a value later when the format has been applied to a drawing.

      You cant control the revision of all of your drawings from a single value in a drawing template.

       

      If you don't use a parameter the text must be entered into the table once the format has been applied to the drawing.

       

        M
        Martin_Hill10-Marble
        10-Marble
        February 24, 2026

        My mistake. I miss read the title block I thought this was revision.

        As RPN has stated you just need to put &format

         

        R
        RPN18-Opal
        18-Opal
        February 24, 2026

        For me it’s look like you want to update the format size, like Ben was mentioning. 

        For this you need to enter the format parameter in your .frm file table. 
        This parameter will reflect the format for each sheet, and will update without replacing the format. 

        &format Displays a drawing label indicating the format size (for example, A1, A0, A, B, and so forth).
        Y
        Yogesh.T14-AlexandriteAuthorAnswer
        14-Alexandrite
        February 24, 2026

        Here is my conclusion:

        ONLY FOR TABLES

        Anything incoming in .dwg from .frm tables, becomes child of .dwg

        It will stay even if changed in .frm table

        &name in .frm table will be asked only once for .dwg (Can be updated / deleted in dwg)

        M
        Martin_Hill10-Marble
        10-Marble
        February 24, 2026

        All tables in the drawing format are copied into the drawing when the format is applied.

        They do not stay linked to the tables in the format file. All other objects in the format remain linked.

         

        This is a good thing. You can change your formats over time if required without inadvertently changing all drawings that were created using that drawing format.

        If you do want to update the tables you can reapply the format and you get to either keep or delete all of the existing tables.

         

         Attributes are a bit more complicated and it depends on whether they are model or drawing attributes and if there is already a model in the drawing when the format is applied. There are many posts related to this in the community.

         

         

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